fanuc 15i-MB Operators Manual

Download

OPERRATOR’S MANUAL (OPERATION)

B-63784EN-1/01

• No part of this manual may be reproduced in any form.

• All specifications and designs are subject to change without notice.

The export of this product is subject to the authorization of the government of the country

from where the product is exported.

In this manual we have tried as much as possible to describe all the various matters.

However, we cannot describe all the matters which must not be done, or which cannot be

done, because there are so many possibilities.

Therefore, matters which are not especially described as possible in this manual should be

regarded as ”impossible”.

This manual contains the program names or device names of other companies, some of

which are registered trademarks of respective owners. However, these names are not followed by  or  in the main body.

B-63784EN-1/01 SAFETY PRECAUTIONS

SAFETY PRECAUTIONS

This section describes the safety precautions related to the use of CNC units. It is essential that these precautions be observed by users to ensure the safe operation of machines equipped with a CNC unit (all descriptions in this section assume this configuration). Note that some precautions are related only to specific functions, and thus may not be applicable to certain CNC units. Users must also observe the safety precautions related to the machine, as described in the relevant manual supplied by the machine tool builder. Before attempting to operate the machine or create a program to control the operation of the machine, the operator must become fully familiar with the contents of this manual and relevant manual supplied by the machine tool builder.

CONTENTS

CONTENTSCONTENTS

1. DEFINITION OF WARNING, CAUTION, AND NOTE.........................s-2

2. GENERAL WARNINGS AND CAUTIONS .............................................s-3

3. WARNINGS AND CAUTIONS RELATED TO PROGRAMMING ........s-5

4. WARNINGS AND CAUTIONS RELATED TO HANDLING .................s-8

5. WARNINGS RELATED TO DAILY MAINTENANCE...........................s-11

s-1

SAFETY PRECAUTIONS B-63784EN-1/01

DEFINITION OF WARNING, CAUTION, AND NOTE

This manual includes safety precautions for protecting the user and preventing damage to the machine. Precautions are classified into Warning and Caution according to their bearing on safety. Also, supplementary information is described as a Note. Read the Warning, Caution, and Note thoroughly before attempting to use the machine

WARNING

Applied when there is a danger of the user being injured or when there is a damage of both the user being injured and the equipment being damaged if the approved procedure is not observed.

CAUTION

Applied when there is a danger of the equipment being damaged, if the approved procedure is not observed.

NOTE

The Note is used to indicate supplementary information other than Warning and Caution.

- Read this manual carefully, and store it in a safe place.

s-2

B-63784EN-1/01 SAFETY PRECAUTIONS

GENERAL WARNINGS AND CAUTIONS

WARNING

1. Never attempt to machine a workpiece without first checking the operation of the machine. Before starting a production run, ensure that the machine is operating correctly by performing a trial run using, for example, the single block, feedrate override, or machine lock function or by operating the machine with neither a tool nor workpiece mounted. Failure to confirm the correct operation of the machine may result in the machine behaving unexpectedly, possibly causing damage to the workpiece and/or machine itself, or injury to the user.

2. Before operating the machine, thoroughly check the entered data. Operating the machine with incorrectly specified data may result in the machine behaving unexpectedly, possibly causing damage to the workpiece and/or machine itself, or injury to the user.

3. Ensure that the specified feedrate is appropriate for the intended operation. Generally, for each machine, there is a maximum allowable feedrate. The appropriate feedrate varies with the intended operation. Refer to the manual provided with the machine to determine the maximum allowable feedrate. If a machine is run at other than the correct speed, it may behave unexpectedly, possibly causing damage to the workpiece and/or machine itself, or injury to the user.

4. When using a tool compensation function, thoroughly check the direction and amount of compensation. Operating the machine with incorrectly specified data may result in the machine behaving unexpectedly, possibly causing damage to the workpiece and/or machine itself, or injury to the user.

5. The parameters for the CNC and PMC are factory-set. Usually, there is not need to change them. When, however, there is not alternative other than to change a parameter, ensure that you fully understand the function of the parameter before making any change. Failure to set a parameter correctly may result in the machine behaving unexpectedly, possibly causing damage to the workpiece and/or machine itself, or injury to the user.

6. Immediately after switching on the power, do not touch any of the keys on the MDI panel until the position display or alarm screen appears on the CNC unit. Some of the keys on the MDI panel are dedicated to maintenance or other special operations. Pressing any of these keys may place the CNC unit in other than its normal state. Starting the machine in this state may cause it to behave unexpectedly.

7. The operator's manual and programming manual supplied with a CNC unit provide an overall description of the machine's functions, including any optional functions. Note that the optional functions will vary from one machine model to another. Therefore, some functions described in the manuals may not actually be available for a particular model. Check the specification of the machine if in doubt.

s-3

SAFETY PRECAUTIONS B-63784EN-1/01

WARNING

8. Some functions may have been implemented at the request of the machine-tool builder. When using such functions, refer to the manual supplied by the machine-tool builder for details of their use and any related cautions.

NOTE

Programs, parameters, and macro variables are stored in nonvolatile memory in the CNC unit. Usually, they are retained even if the power is turned off. Such data may be deleted inadvertently, however, or it may prove necessary to delete all data from nonvolatile memory as part of error recovery. To guard against the occurrence of the above, and assure quick restoration of deleted data, backup all vital data, and keep the backup copy in a safe place.

s-4

B-63784EN-1/01 SAFETY PRECAUTIONS

WARNINGS AND CAUTIONS RELATED TO PROGRAMMING

This section covers the major safety precautions related to programming. Before attempting to perform programming, read the supplied operator's manual and programming manual carefully such that you are fully familiar with their contents.

WARNING

1.Coordinate system setting

If a coordinate system is established incorrectly, the machine may behave unexpectedly as a result of the program issuing an otherwise valid move command. Such an unexpected operation may damage the tool, the machine itself, the workpiece, or cause injury to the user.

2.Positioning by nonlinear interpolation

When performing positioning by nonlinear interpolation (positioning by nonlinear movement between the start and end points), the tool path must be carefully confirmed before performing programming. Positioning involves rapid traverse. If the tool collides with the workpiece, it may damage the tool, the machine itself, the workpiece, or cause injury to the user.

3.Function involving a rotation axis

When programming polar coordinate interpolation or normal-direction (perpendicular) control, pay careful attention to the speed of the rotation axis. Incorrect programming may result in the rotation axis speed becoming excessively high, such that centrifugal force causes the chuck to lose its grip on the workpiece if the latter is not mounted securely. Such mishap is likely to damage the tool, the machine itself, the workpiece, or cause injury to the user.

4.Inch/metric conversion

Switching between inch and metric inputs does not convert the measurement units of data such as the workpiece origin offset, parameter, and current position. Before starting the machine, therefore, determine which measurement units are being used. Attempting to perform an operation with invalid data specified may damage the tool, the machine itself, the workpiece, or cause injury to the user.

5.Constant surface speed control

When an axis subject to constant surface speed control approaches the origin of the workpiece coordinate system, the spindle speed may become excessively high. Therefore, it is necessary to specify a maximum allowable speed. Specifying the maximum allowable speed incorrectly may damage the tool, the machine itself, the workpiece, or cause injury to the user.

s-5

SAFETY PRECAUTIONS B-63784EN-1/01

WARNING

6.Stroke check

After switching on the power, perform a manual reference position return as required. Stroke check is not possible before manual reference position return is performed. Note that when stroke check is disabled, an alarm is not issued even if a stroke limit is exceeded, possibly damaging the tool, the machine itself, the workpiece, or causing injury to the user.

7. Tool post interference check

A tool post interference check is performed based on the tool data specified during automatic operation. If the tool specification does not match the tool actually being used, the interference check cannot be made correctly, possibly damaging the tool or the machine itself, or causing injury to the user. After switching on the power, or after selecting a tool post manually, always start automatic operation and specify the tool number of the tool to be used.

8. Absolute/incremental mode

If a program created with absolute values is run in incremental mode, or vice versa, the machine may behave unexpectedly.

9.Plane selection

If an incorrect plane is specified for circular interpolation, helical interpolation, or a canned cycle, the machine may behave unexpectedly. Refer to the descriptions of the respective functions for details.

10.Torque limit skip

Before attempting a torque limit skip, apply the torque limit. If a torque limit skip is specified without the torque limit actually being applied, a move command will be executed without performing a skip.

11.Programmable mirror image

Note that programmed operations vary considerably when a programmable mirror image is enabled.

12.Compensation function

If a command based on the machine coordinate system or a reference position return command is issued in compensation function mode, compensation is temporarily canceled, resulting in the unexpected behavior of the machine. Before issuing any of the above commands, therefore, always cancel compensation function mode.

s-6

B-63784EN-1/01 SAFETY PRECAUTIONS

WARNINGS AND CAUTIONS RELATED TO HANDLING

This section presents safety precautions related to the handling of machine tools. Before attempting to operate your machine, read the supplied operator's manual and programming manual carefully, such that you are fully familiar with their contents.

WARNING

1.Manual operation

When operating the machine manually, determine the current position of the tool and workpiece, and ensure that the movement axis, direction, and feedrate have been specified correctly. Incorrect operation of the machine may damage the tool, the machine itself, the workpiece, or cause injury to the operator.

2.Manual reference position return

After switching on the power, perform manual reference position return as required. If the machine is operated without first performing manual reference position return, it may behave unexpectedly. Stroke check is not possible before manual reference position return is performed. An unexpected operation of the machine may damage the tool, the machine itself, the workpiece, or cause injury to the user.

3.Manual numeric command

When issuing a manual numeric command, determine the current position of the tool and workpiece, and ensure that the movement axis, direction, and command have been specified correctly, and that the entered values are valid. Attempting to operate the machine with an invalid command specified may damage the tool, the machine itself, the workpiece, or cause injury to the operator.

4.Manual handle feed

In manual handle feed, rotating the handle with a large scale factor, such as 100, applied causes the tool and table to move rapidly. Careless handling may damage the tool and/or machine, or cause injury to the user.

5.Disabled override

If override is disabled (according to the specification in a macro variable) during threading, rigid tapping, or other tapping, the speed cannot be predicted, possibly damaging the tool, the machine itself, the workpiece, or causing injury to the operator.

s-7

SAFETY PRECAUTIONS B-63784EN-1/01

WARNING

6.Origin/preset operation

Basically, never attempt an origin/preset operation when the machine is operating under the control of a program. Otherwise, the machine may behave unexpectedly, possibly damaging the tool, the machine itself, the tool, or causing injury to the user.

7.Workpiece coordinate system shift

Manual intervention, machine lock, or mirror imaging may shift the workpiece coordinate system. Before attempting to operate the machine under the control of a program, confirm the coordinate system carefully. If the machine is operated under the control of a program without making allowances for any shift in the workpiece coordinate system, the machine may behave unexpectedly, possibly damaging the tool, the machine itself, the workpiece, or causing injury to the operator.

8.Software operator's panel and menu switches

Using the software operator's panel and menu switches, in combination with the MDI panel, it is possible to specify operations not supported by the machine operator's panel, such as mode change, override value change, and jog feed commands. Note, however, that if the MDI panel keys are operated inadvertently, the machine may behave unexpectedly, possibly damaging the tool, the machine itself, the workpiece, or causing injury to the user.

9.Manual intervention

If manual intervention is performed during programmed operation of the machine, the tool path may vary when the machine is restarted. Before restarting the machine after manual intervention, therefore, confirm the settings of the manual absolute switches, parameters, and absolute/incremental command mode.

10.Feed hold, override, and single block

The feed hold, feedrate override, and single block functions can be disabled using custom macro system variable #3004. Be careful when operating the machine in this case.

11.Dry run

Usually, a dry run is used to confirm the operation of the machine. During a dry run, the machine operates at dry run speed, which differs from the corresponding programmed feedrate. Note that the dry run speed may sometimes be higher than the programmed feed rate.

s-8

B-63784EN-1/01 SAFETY PRECAUTIONS

WARNING

12.Cutter and tool nose radius compensation in MDI mode

Pay careful attention to a tool path specified by a command in MDI mode, because cutter or tool nose radius compensation is not applied. When a command is entered from the MDI to interrupt in automatic operation in cutter or tool nose radius compensation mode, pay particular attention to the tool path when automatic operation is subsequently resumed. Refer to the descriptions of the corresponding functions for details.

13.Program editing

If the machine is stopped, after which the machining program is edited (modification, insertion, or deletion), the machine may behave unexpectedly if machining is resumed under the control of that program. Basically, do not modify, insert, or delete commands from a machining program while it is in use.

s-9

SAFETY PRECAUTIONS B-63784EN-1/01

WARNINGS RELATED TO DAILY MAINTENANCE

WARNING

1.Memory backup battery replacement

When replacing the memory backup batteries, keep the power to the machine (CNC) turned on, and apply an emergency stop to the machine. Because this work is performed with the power on and the cabinet open, only those personnel who have received approved safety and maintenance training may perform this work.

When replacing the batteries, be careful not to touch the high-voltage circuits (marked with an insulating cover). Touching the uncovered high-voltage circuits presents an extremely dangerous electric shock hazard.

NOTE

The CNC uses batteries to preserve the contents of its memory, because it must retain data such as programs, offsets, and parameters even while external power is not applied. If the battery voltage drops, a low battery voltage alarm is displayed on the machine operator's panel or screen. When a low battery voltage alarm is displayed, replace the batteries within a week. Otherwise, the contents of the CNC's memory will be lost. Refer to the Maintenance manual for details of the battery replacement procedure.

and fitted

s-10

B-63784EN-1/01 SAFETY PRECAUTIONS

WARNING

2.Absolute pulse coder battery replacement

When replacing the batteries, be careful not to touch the high-voltage circuits (marked

and fitted with an insulating cover). Touching the uncovered high-voltage circuits presents an extremely dangerous electric shock hazard.

NOTE

The absolute pulse coder uses batteries to preserve its absolute position. If the battery voltage drops, a low battery voltage alarm is displayed on the machine operator's panel or screen. When a low battery voltage alarm is displayed, replace the batteries within a week. Otherwise, the absolute position data held by the pulse coder will be lost. Refer to the Maintenance manual for details of the battery replacement procedure.

s-11

SAFETY PRECAUTIONS B-63784EN-1/01

WARNING

3.Fuse replacement

For some units, the chapter covering daily maintenance in the operator's manual or programming manual describes the fuse replacement procedure. Before replacing a blown fuse, however, it is necessary to locate and remove the cause of the blown fuse. For this reason, only those personnel who have received approved safety and maintenance training may perform this work. When replacing a fuse with the cabinet open, be careful not to touch the high-voltage circuits (marked

and fitted with an insulating cover).

Touching an uncovered high-voltage circuit presents an extremely dangerous electric shock hazard.

s-12

B-63784EN-1/01 TABLE OF CONTENTS

SAFETY PRECAUTIONS.......................................................................... s-1

I GENERAL

1 GENERAL ..............................................................................................3

1.1 GENERAL FLOW OF OPERATION OF CNC MACHINE TOOL ...................5

1.2 NOTES ON READING THIS MANUAL..........................................................7

II OPERATION

1 GENERAL ............................................................................................11

1.1 MANUAL OPERATION................................................................................12

1.2 TOOL MOVEMENT BY PROGRAMING – AUTOMATIC OPERATION.......14

1.3 AUTOMATIC OPERATION..........................................................................16

1.4 TESTING A PROGRAM ..............................................................................18

1.4.1 Check by Running the Machine ............................................................................ 19

1.4.2 How to View the Position Display Change without Running the Machine .......... 21

1.5 EDITING A PART PROGRAM.....................................................................22

1.6 DISPLAYING AND SETTING DATA............................................................23

1.7 DISPLAY......................................................................................................27

1.7.1 Program Display.................................................................................................... 27

1.7.2 Current Position Display ....................................................................................... 29

1.7.3 Operator Message Display..................................................................................... 30

1.7.4 Alarm Display........................................................................................................ 30

1.7.5 Parts Count Display, Run Time Display ............................................................... 31

1.7.6 Graphic Display..................................................................................................... 32

1.8 DATA INPUT/OUTPUT................................................................................33

2 OPERATIONAL DEVICES ...................................................................34

2.1 SETTING AND DISPLAY UNITS.................................................................35

2.1.1 9.5"/10.4" LCD Unit.............................................................................................. 36

2.1.2 MDI Unit ............................................................................................................... 37

2.1.3 MDI Unit (Full-keyboard) ..................................................................................... 38

2.1.4 MDI Unit (Main Panel A/B) for Machine Operator's Panel.................................. 39

2.2 EXPLANATION OF THE KEYBOARD.........................................................40

2.3 OPERATION SCREEN DISPLAY................................................................42

2.4 OPERATIONS SUPPORTED BY EACH OPERATION SCREEN ...............43

c-1

TABLE OF CONTENTS B-63784EN-1/01

2.5 FUNCTION KEYS AND SOFT KEYS ..........................................................44

2.5.1 General Screen Operations .................................................................................... 44

2.5.2 Function Keys........................................................................................................ 45

2.5.3 Soft Keys ............................................................................................................... 46

2.5.4 Function Selection Keys........................................................................................ 46

2.5.5 Chapter selection keys........................................................................................... 47

2.5.5.1 Position ..............................................................................................................47

2.5.5.2 Program.............................................................................................................. 48

2.5.5.3 Offset/Setting .....................................................................................................49

2.5.5.4 System................................................................................................................ 50

2.5.5.5 Messages ............................................................................................................ 51

2.5.5.6 Drawing..............................................................................................................51

2.5.6 Key Input and Input Buffer.................................................................................... 52

2.5.6.1 Inserting characters ............................................................................................52

2.5.6.2 Deleting characters............................................................................................. 53

2.5.7 Warning Messages................................................................................................. 54

2.6 LANGUAGE SELECTION............................................................................55

2.7 EXTERNAL I/O DEVICES ...........................................................................56

2.7.1 FANUC Handy File............................................................................................... 58

2.7.2 FANUC Floppy Cassette ....................................................................................... 58

2.7.3 FANUC FA Card................................................................................................... 59

2.8 POWER ON/OFF.........................................................................................60

2.8.1 Turning on the Power ............................................................................................ 60

2.8.2 Power Disconnection............................................................................................. 61

3 MANUAL OPERATION ........................................................................62

3.1 MANUAL REFERENCE POSITION RETURN.............................................63

3.2 JOG FEED...................................................................................................65

3.3 INCREMENTAL FEED.................................................................................67

3.4 MANUAL HANDLE FEED............................................................................68

3.5 MANUAL FEED IN A SPECIFIED DIRECTION...........................................70

3.6 MANUAL NUMERIC COMMAND ................................................................72

3.7 MANUAL ABSOLUTE ON AND OFF...........................................................79

3.8 EFFECT OF MANUAL INTERVENTION .....................................................86

3.9 THREE-DIMENSIONAL HANDLE FEED.....................................................87

3.9.1 Handle Feed Interruption in the Longitudinal Direction of the Tool.................... 88

3.9.2 Handle Feed in the Transverse Direction of the Tool ........................................... 92

3.9.3 Rotational Handle Feed and Interruption Around the Center of the Tool Tip...... 96

3.9.4 Control Point Compensation in Three-dimensional Handle Feed......................... 99

c-2

B-63784EN-1/01 TABLE OF CONTENTS

3.10 CHANGING TOOL LENGTH COMPENSATION

IN THE LONGITUDINAL DIRECTION OF THE TOOL ..............................101

3.11 TOOL HOLDER OFFSET ..........................................................................102

3.12 ROTARY AXIS ORIGIN COMPENSATION

AND ROTARY AXIS OFFSET ...................................................................103

3.13 PRECAUTIONS DURING 3-DIMENSIONAL HANDLE FEED ...................104

3.14 DISPLAYING THE COORDINATES OF THE TOOL TIP ..........................108

3.15 DISPLAYING PULSE VALUES AND AMOUNT OF MOVEMENT

BY MANUAL INTERRUPT.........................................................................110

3.16 MANUAL INTERRUPTION FUNCTION

FOR THREE-DIMENSIONAL COORDINATE CONVERSION ..................112

4 AUTOMATIC OPERATION ................................................................114

4.1 DNC OPERATION .....................................................................................115

4.2 MEMORY OPERATION.............................................................................116

4.3 MDI OPERATION ......................................................................................117

4.4 SELECTION OF EXECUTION PROGRAMS.............................................120

4.4.1 Program Number Search...................................................................................... 120

4.4.2 Search by Sequence Number............................................................................... 121

4.4.3 Rewind................................................................................................................. 122

4.5 EXECUTING AUTOMATIC OPERATION..................................................123

4.6 STOP/TERMINATION OF AUTOMATIC OPERATION .............................124

4.7 PROGRAM RESTART...............................................................................127

4.8 OUTPUT OF PROGRAM RESTART M, S, T AND B CODES...................138

4.9 BLOCK RESTART .....................................................................................141

4.10 TOOL WITHDRAWAL AND RETURN .......................................................149

4.11 RETRACE..................................................................................................162

4.12 ACTIVE BLOCK CANCEL .........................................................................172

4.13 MANUAL HANDLE INTERRUPT ...............................................................174

4.14 MANUAL INTERVENTION AMOUNT RETURN

DURING AUTOMATIC OPERATION.........................................................177

4.15 SIMULTANEOUS AUTOMATIC AND MANUAL OPERATION ..................178

5 TEST OPERATION ............................................................................181

5.1 MACHINE LOCK AND AUXILIARY FUNCTION LOCK .............................182

5.2 DRY RUN...................................................................................................184

5.3 SINGLE BLOCK.........................................................................................186

c-3

TABLE OF CONTENTS B-63784EN-1/01

6 SAFETY FUNCTIONS........................................................................188

6.1 EMERGENCY STOP .................................................................................189

6.2 OVERTRAVEL...........................................................................................190

6.3 STROKE CHECK.......................................................................................192

6.4 STROKE LIMIT CHECK PRIOR TO PERFORMING MOVEMENT ...........197

7 ALARMS AND SELF DIAGNOSTC FUNCTIONS ..............................200

7.1 CHECKING WITH THE DIAGNOSIS SCREEN.........................................201

7.1.1 DI/DO Monitor Function..................................................................................... 203

7.1.2 Waveform Diagnosis Function............................................................................ 203

7.2 INTERNAL POSITION COMPENSATION DATA DISPLAY FUNCTION...204

7.3 COORDINATE SYSTEM RELATED DATA DISPLAY ...............................214

7.4 PERIODIC MAINTENANCE SCREEN.......................................................215

7.5 MAINTENANCE INFORMATION SCREEN...............................................226

8 EDITING PROGRAMS .......................................................................227

8.1 INPUTTING AND OUTPUTTING PROGRAMS.........................................228

8.1.1 Inputting Programs .............................................................................................. 228

8.1.2 Outputting Programs............................................................................................ 236

8.1.3 Collating Programs.............................................................................................. 245

8.1.4 Keys and Program Encryption............................................................................. 248

8.1.5 Stored Program Lengths and Number of Registerable Programs........................ 253

8.2 CURSOR ...................................................................................................254

8.2.1 Cursor/Editing Units/Words................................................................................ 254

8.2.2 Positioning the Cursor ......................................................................................... 255

8.3 PROGRAM NUMBER SEARCH................................................................256

8.4 WORD SEARCH/ADDRESS SEARCH .....................................................258

8.4.1 Word Search ........................................................................................................ 258

8.4.2 Address Search .................................................................................................... 260

8.4.3 Search Repeat Function....................................................................................... 261

8.5 INSERTING WORDS AND BLOCKS ........................................................262

8.6 CHANGING WORDS AND BLOCKS.........................................................263

8.6.1 Overwriting Words.............................................................................................. 263

8.6.2 Replacing Words and Character Strings.............................................................. 264

8.6.3 Replacing Addresses............................................................................................ 268

8.7 DELETING WORDS AND BLOCKS ..........................................................270

8.8 CUTTING AND PASTING..........................................................................271

8.8.1 Basic Operations.................................................................................................. 271

c-4

B-63784EN-1/01 TABLE OF CONTENTS

8.8.2 Copying, Moving, and Deleting Words and Blocks ............................................ 275

8.9 CANCELING THE EFFECTS OF EDITING WORDS AND BLOCKS ........276

8.10 COPYING PROGRAMS ............................................................................278

8.11 MERGING PROGRAMS............................................................................279

8.12 DELETING PROGRAMS ...........................................................................280

8.13 RESTORING A DELETED PROGRAM .....................................................282

8.14 BACKGROUND EDITING..........................................................................283

8.15 EDITING TWO PROGRAMS SIMULTANEOUSLY ...................................285

8.16 EDITING PROGRAMS IN OPERATION....................................................287

8.17 CONDENSING THE PROGRAM MEMORY..............................................288

8.18 CREATING PROGRAMS USING THE MDI PANEL..................................290

8.19 PLAYBACK................................................................................................291

8.20 AUTOMATICALLY INSERTING SEQUENCE NUMBERS.........................295

8.21 STAMPING THE MACHINING TIME.........................................................296

9 SETTING AND DISPLAYING DATA ..................................................299

9.1 DISPLAYING AND SETTING TOOL OFFSET VALUES ...........................300

9.2 DISPLAYING AND SETTING WORKPIECE ORIGIN OFFSETS ..............307

9.3 DISPLAY AND SETTING OF SETTING PARAMETERS ..........................311

9.4 DISPLAYING AND SETTING CUSTOM MACRO VARIABLE VALUES....317

9.5 INPUT/OUTPUT OPERATION OF CUSTOM MACRO

COMMON VARIABLES .............................................................................321

9.6 DISPLAYING AND SETTING PARAMETERS...........................................325

9.7 DISPLAYING AND SETTING PITCH ERROR COMPENSATION DATA ..332

9.8 MANUAL TOOL LENGTH MEASUREMENT.............................................333

9.9 MANUAL WORKPIECE ORIGIN SETTING...............................................337

9.10 TOOL LENGTH/WORKPIECE ORIGIN MEASUREMENT ........................343

9.11 MENU SWITCHES ....................................................................................362

9.12 DISPLAYING AND SETTING TOOL LIFE MANAGEMENT DATA............364

9.13 DISPLAYING AND SETTING THE SOFTWARE OPERATOR'S PANEL..374

9.14 DISPLAYING AND SETTING TOOL OFFSET DATA BASED

ON TOOL NUMBERS................................................................................377

9.15 FLOATING REFERENCE POSITION SETTING .......................................387

9.16 SERVO SPINDLE SCREEN ......................................................................389

9.17 COMMUNICATION SETTING SCREEN ...................................................390

9.18 HIGH-SPEED HIGH-PRECISION MACHINING SETTING SCREEN........393

9.19 CALCULATION KEY..................................................................................400

9.20 POWER MATE CNC MANAGER FUNCTION...........................................403

c-5

TABLE OF CONTENTS B-63784EN-1/01

9.21 MODEM CARD SETTING SCREEN..........................................................410

9.22 CHANGING ACTIVE OFFSET VALUE WITH MANUAL MOVE................413

9.23 DO SIGNAL OUTPUT BY SOFT KEY .......................................................418

9.24 AUTOMATIC FEEDRATE CONTROL BY AREA.......................................419

9.25 DIAMETER ENTRY FOR TOOL COMPENSATION VALUE .....................422

10 DISPLAY ............................................................................................423

10.1 PROGRAM DISPLAY ................................................................................424

10.2 PROGRAM AND SEQUENCE NUMBER DISPLAY, STATUS DISPLAY,

AND DATA SETTING AND INPUT/OUTPUT OPERATION WARNING

DISPLAY....................................................................................................431

10.3 PROGRAM AND SEQUENCE NUMBER DISPLAY ..................................432

10.4 STATUS DISPLAY AND DATA SETTING AND INPUT/OUTPUT

OPERATION WARNING DISPLAY ...........................................................433

10.5 CURRENT POSITION DISPLAY ...............................................................437

10.5.1 Presetting the Current Position............................................................................ 442

10.5.2 Presetting a Workpiece Coordinate System ........................................................ 444

10.6 OPERATOR MESSAGE DISPLAY............................................................446

10.7 ALARM MESSAGE DISPLAY....................................................................448

10.8 TOOL PATH DRAWING ............................................................................450

10.9 OPERATING MONITOR SCREEN............................................................463

10.10 DISPLAY AND SETTING OF THE PARTS COUNTS,

OPERATING TIME, AND CLOCK .............................................................465

10.11 BACKGROUND DRAWING.......................................................................468

10.12 FLOPPY DIRECTORY SCREEN...............................................................487

10.13 MEMORY CARD SCREEN........................................................................493

10.14 SUB SCREENS .........................................................................................499

10.15 HELP FUNCTION......................................................................................510

10.15.1 Help Menu ........................................................................................................... 511

10.15.2 Alarm Help .......................................................................................................... 512

10.15.3 G Code Help ........................................................................................................ 515

10.15.4 Moving the Cursor between the Ordinary Operation Screen and the Help

Screen .................................................................................................................. 517

10.15.5 Notes 518

10.16 DIRECTORY DISPLAY / PUNCH FOR EACH GROUP ............................519

10.17 PROGRAM NAME 48 CHARACTERS ......................................................523

10.18 FINE TORQUE SENSING .........................................................................526

10.19 2-LCD-UNIT CONNECTION FUNCTION ..................................................538

c-6

B-63784EN-1/01 TABLE OF CONTENTS

10.20 αi SERVO AND SPINDLE INFORMATION SCREENS.............................540

11 CLEARING THE SCREEN .................................................................541

11.1 CLEARING THE SCREEN ........................................................................542

11.1.1 Erase Screen Display........................................................................................... 542

11.1.2 Automatic Erase Screen Display......................................................................... 543

12 INPUTTING/OUTPUTTING DATA......................................................544

12.1 FILES.........................................................................................................545

12.2 SPECIFYING PARAMETERS REQUIRED FOR INPUT/OUTPUT............547

12.2.1 Setting Parameter Screen..................................................................................... 547

12.2.2 Communication Setting Screen ........................................................................... 548

12.3 INPUTTING AND OUTPUTTING PROGRAMS.........................................551

12.3.1 Outputting Programs............................................................................................ 551

12.3.2 Program Inputting................................................................................................ 557

12.4 INPUTTING AND OUTPUTTING SYSTEM PARAMETERS .....................561

12.4.1 Outputting System Parameters ............................................................................ 561

12.4.2 Inputting System Parameters ............................................................................... 563

12.5 INPUTTING AND OUTPUTTING TOOL OFFSET DATA ..........................564

12.5.1 Outputting Tool Offset Data................................................................................ 564

12.5.2 Inputting Tool Offset Data .................................................................................. 566

12.6 INPUTTING AND OUTPUTTING WORKPIECE ZERO POINT

OFFSET DATA ..........................................................................................567

12.6.1 Outputting Workpiece zero point offset data ...................................................... 567

12.6.2 Inputting System Parameters ............................................................................... 569

12.7 INPUTTING AND OUTPUTTING CUSTOM MACRO VARIABLE .............570

12.7.1 Outputting Custom Macro Variable.................................................................... 570

12.7.2 Inputting Custom Macro Variable....................................................................... 572

12.8 INPUTTING AND OUTPUTTING THREE-DIMENSIONAL ERROR

COMPENSATION DATA ...........................................................................573

12.8.1 Outputting Three-dimensional Error Compensation Data................................... 573

12.8.2 Inputting Three-dimensional Error Compensation Data ..................................... 575

12.9 INPUTTING AND OUTPUTTING TOOL OFFSET DATA

BY TOOL NUMBER...................................................................................576

12.9.1 Outputting Tool Offset Data by Tool Number.................................................... 576

12.9.2 Inputting Tool Offset Data by Tool Number....................................................... 578

12.10 INPUTTING AND OUTPUTTING FIXTURE OFFSET DATA.....................579

12.10.1 Outputting Fixture Offset Data............................................................................ 579

c-7

TABLE OF CONTENTS B-63784EN-1/01

12.10.2 Inputting Fixture Offset Data .............................................................................. 581

12.11 INPUTTING AND OUTPUTTING ROTARY HEAD DYNAMIC TOOL

OFFSET DATA ..........................................................................................582

12.11.1 Outputting Rotary Head Dynamic Tool Offset Data........................................... 582

12.11.2 Inputting Rotary Head Dynamic Tool Offset Data.............................................. 584

12.12 OUTPUTTING SYSTEM CONFIGURATION DATA ..................................585

12.12.1 Outputting System Configuration Data ............................................................... 585

12.13 INPUTTING AND OUTPUTTING DATA

USING THE FLOPPY DIRECTORY SCREEN ..........................................587

12.14 INPUTTING AND OUTPUTTING DATA

USING THE MEMORY CARD SCREEN ...................................................588

12.15 EXTERNAL I/O EQUIPMENT CONTROL .................................................589

12.16 SCREEN HARD COPY FUNCTION ..........................................................590

13 AXIS CONTROL.................................................................................592

13.1 AXIS CONTROL BY THE PMC .................................................................593

13.2 MIRROR IMAGE........................................................................................594

14 ABSOLUTE-POSITION DETECTION ................................................597

III MAINTENANCE

1 INVESTIGATION OF TROUBLE GENERATION SITUATION ...........603

1.1 DISPLAY OF SYSTEM CONFIGURATION SCREEN ...............................604

1.2 SYSTEM LOG SCREEN............................................................................606

1.2.1 Displaying the Contents of Memory ................................................................... 608

APPENDIX

A STATUS WHEN TURNING POWER ON, WHEN RESET ..................611

c-8

I GENERAL

B-63784EN-1/01 GENERAL 1.GENERAL

1 GENERAL

Operator’s Manuals consist of the PROGRAMMING Manual and OPERATION Manual.

About this Operator’s Manual

OPERATOR’S MANUAL (PROGRAMMING) (B-63784EN)

I. GENERAL

Describes chapter organization, applicable models, related manuals, and notes for reading this manual.

II. PROGRAMMING

Describes each function: Format used to program functions in the NC language, characteristics, and restrictions..

APPENDIX

Lists tape codes, valid data ranges, and alarms.

OPERATOR’S MANUAL (OPERATION) (B-63784EN-1)

I. GENERAL

Describes chapter organization, applicable models, related manuals, and notes for reading this manual.

II. OPERATION

Describes the manual operation and automatic operation of a machine, procedures for inputting and outputting data, and procedures for editing a program.

III. MAINTENANCE

Describes investigation of trouble generation situation.

APPENDIX

Status when turning power on, when reset Some functions described in this manual may not be applied to some products. For detail, refer to the DESCRIPTIONS manual (B63782EN).

Applicable product name

This manual does not describe parameters in detail. For details on parameters mentioned in this manual, refer to the manual for parameters (B-63790EN).

This manual describes all optional functions. Look up the options incorporated into your system in the manual written by the machine tool builder.

The models covered by this manual, and their abbreviations are:

Product name Abbreviations

FANUC Series 15i-MB 15i-MB Series 15i

FANUC Series 150i-MB 150i-MB Series 150i

- 3 -

1.GENERAL GENERAL B-63784EN-1/01

Special symbols

This manual uses the following symbols: P_ : Indicates a combination of axes such as X_ Y_ Z (used in

PROGRAMMING.). ; : Indicates the end of a block. It actually corresponds to the ISO

code LF or EIA code CR.

Related manuals

The table below lists manuals related to MODEL B of Series 15i, and Series 150i. In the table, this manual is marked with an asterisk (*).

Table 1 (a) Related Manuals

Manual name

DESCRIPTIONS B-63782EN CONNECTION MANUAL (HARDWARE) B-63783EN CONNECTION MANUAL (FUNCTION) B-63783EN-1 OPERATOR'S MANUAL (PROGRAMMING) B-63784EN OPERATOR'S MANUAL (OPERATION) B-63784EN-1 * MAINTENANCE MANUAL B-63785EN PARAMETER MANUAL B-63790EN

Specification

number

- 4 -

B-63784EN-1/01 GENERAL 1.GENERAL

1.1 GENERAL FLOW OF OPERATION OF CNC MACHINE

TOOL

When machining the part using the CNC machine tool, first prepare the program, then operate the CNC machine by using the program. (1) First, prepare the program from a part drawing to operate the CNC

machine tool. How to prepare the program is described in the

OPERATOR’S MANUAL (PROGRAMMING). (2) The program is to be read into the CNC system. Then, mount the

workpieces and tools on the machine, and operate the tools

according to the programming. Finally, execute the machining

actually. How to operate the CNC system is described in the

OPERATOR’S MANUAL (OPERATION).

Part

drawing

PROGRAMMING

Part programming

CNC MACHINE TOOL

OPERATION

Before the actual programming, make the machining plan for how to machine the part. Machining plan-

1. Determination of workpieces machining range

2. Method of mounting workpieces on the machine tool

3. Machining sequence in every machining process

4. Machining tools and machining

Decide the machining method in every machining process.

Machining process

Machining procedure

1. Machining method : Rough Semi Finish

2. Machining tools

3. Machining conditions : Feedrate Cutting depth

4. Tool path

123

Feed

cutting

Side

cutting

Hole

machining

- 5 -

1.GENERAL GENERAL B-63784EN-1/01

Tool

Side cutting

Face cutting

Hole machining

Prepare the program of the tool path and machining condition according to the workpiece figure, for each machining.

- 6 -

B-63784EN-1/01 GENERAL 1.GENERAL

1.2 NOTES ON READING THIS MANUAL

NOTE

1 The function of an CNC machine tool system

depends not only on the CNC, but on the combination of the machine tool, its magnetic cabinet, the servo system, the CNC, the operator's panels, etc. It is too difficult to describe the function, programming, and operation relating to all combinations. This manual generally describes these from the stand-point of the CNC. So, for details on a particular CNC machine tool, refer to the manual issued by the machine tool builder, which should take precedence over this manual.

2 Headings are placed in the left margin so that the

reader can easily access necessary information. When locating the necessary information, the reader can save time by searching though these headings.

3 Machining programs, parameters, variables, etc. are

stored in the CNC unit internal non-volatile memory. In general, these contents are not lost by the switching ON/OFF of the power. However, it is possible that a state can occur where precious data stored in the non-volatile memory has to be deleted, because of deletions from a maloperation, or by a failure restoration. In order to restore rapidly when this kind of mishap occurs, it is recommended that you create a copy of the various kinds of data beforehand.

4 This manual describes as many reasonable

variations in equipment usage as possible. It cannot address every combination of features, options and commands that should not be attempted. If a particular combination of operations is not described, it should not be attempted.

- 7 -

II OPERATION

B-63784EN-1/01 OPERATION 1.GENERAL

1 GENERAL

- 11 -

1.GENERAL OPERATION B-63784EN-1/01

1.1 MANUAL OPERATION

Explanations

- Manual reference position return

The CNC machine tool has a position used to determine the machine position. This position is called the reference position, where the tool is replaced or the coordinate are set. Ordinarily, after the power is turned on, the tool is moved to the reference position. Manual reference position return is to move the tool to the reference position using switches and pushbuttons located on the operator's panel.(See II-3.1)

Reference Position

Tool

Machine operator’s panel

Fig.1.1 (a) Manual reference position return

The tool can be moved to the reference position also with program commands. This operation is called automatic reference position return (See Programming Manual II-6).

- 12 -

B-63784EN-1/01 OPERATION 1.GENERAL

- The tool movement by manual operation

Using machine operator's panel switches, pushbuttons, or the manual handle, the tool can be moved along each axis.

Machine operator's panel

Manual pulse generator

Tool

Workpiece

Fig.1.1 (b) The tool movement by manual operation

The tool can be moved in the following ways: (i) Jog feed (See Section II-3.2)

The tool moves continuously while a pushbutton remains pressed. (ii) Incremental feed (See Section II-3.3)

The tool moves by the predetermined distance each time a button

is pressed. (iii) Manual handle feed (See Section II-3.4)

By rotating the manual handle, the tool moves by the distance

corresponding

to the degree of handle rotation. (iv) Manual feed at an arbitrary angle (See Section II-3.5)

The tool moves in an arbitrary direction on a plane. (v) Manual numeric command (See Section II-3.6)

By entering numeric data from the MDI keyboard, the tool moves

through the distance corresponding to the entered data.

- 13 -

1.GENERAL OPERATION B-63784EN-1/01

1.2

TOOL MOVEMENT BY PROGRAMING – AUTOMATIC OPERATION

Explanations

- Memory operation

Automatic operation is to operate the machine according to the created program. It includes memory, MDI and DNC operations. (See Section II-4).

Program

O1000 ; M_ S_ T_ ; G92 X_ ; G00 ; G01 ;

: :

Fig. 1.2 (a) Tool Movement by Programming

Tool

After the program is once registered in memory of CNC, the machine can be run according to the program instructions. This operation is called memory operation.

CNC

Memory

Machine

Fig. 1.2 (b) Memory Operation

- 14 -

B-63784EN-1/01 OPERATION 1.GENERAL

- MDI operation

After the program is entered, as an command group, from the MDI keyboard, the machine can be run according to the program. This operation is called MDI operation.

- DNC operation

CNC MDI keyboard

Program entry by manual

Fig.1.2 (c) MDI operation

Machine

In this mode of operation, the program is not registered in the CNC memory. It is read from the external input/output devices instead. This is called DNC operation. This mode is useful when the program is too large to fit the CNC memory.

- 15 -

1.GENERAL OERATION B-63784EN-1/01

1.3 AUTOMATIC OPERATION

Explanations

- Program selection

Select the program used for the workpiece. Ordinarily, one program is prepared for one workpiece. If two or more programs are in memory, select the program to be used, by searching the program number (Section II-4.4.1).

In memory or on a tape

O1001 G92

M30 O1002 G92

Program number

Work-1 program

Program number

Work-2 program

Program number search

utomatic

operation

- Start and stop

M30 O1003 G92

M30

Fig.1.3 (a) Program Selection for Automatic Operation

Program number

Work-3 program

Pressing the cycle start pushbutton causes automatic operation to start. By pressing the feed hold or reset pushbutton, automatic operation pauses or stops. By specifying the program stop or program termination command in the program, the running will stop during automatic operation. When one process machining is completed, automatic operation stops. (See Section II-4)

Cycle start

Feed hold Reset

Stop

Start

utomatic operation

Program stop Program end

Fig.1.3 (b) Start and Stop for Automatic Operation

Stop caused by program

- 16 -

B-63784EN-1/01 OERATION 1.GENERAL

- Restart

You can continue machining of paused workpieces. If, for example, the tool breaks during machining, you can replace the tool, and then restart machining. (Refer to II-4.7.)

- Handle interruption

Tool

Workpiec e Workpiec e

When machi ning of a paused workpiece is rest arted. When a t ool breaks

Fig.1.3 (c) Restart on automatic operation

Paused drilling

Tool

Tool breakage

While automatic operation is being executed, tool movement can overlap automatic operation by rotating the manual handle. (See Section II-4.13)

Tool position during automatic operation

tion

Programmed depth of cut

Tool position after handle interru

Depth of cut by

Fig.1.3 (d) Handle Interruption for Automatic Operation

- 17 -

1.GENERAL OERATION B-63784EN-1/01

1.4 TESTING A PROGRAM

Before machining is started, the automatic running check can be executed. It checks whether the created program can operate the machine as desired. This check can be accomplished by running the machine actually or viewing the position display change (without running the machine) (See Section II-5).

- 18 -

B-63784EN-1/01 OERATION 1.GENERAL

1.4.1 Check by Running the Machine

Explanations

- Dry run

Remove the workpiece, check only movement of the tool. Select the tool movement rate using the dial on the operator's panel. (See Section II-5.2)

Tool

- Feedrate override

Table

Fig.1.4 (a) Dry run

Check the program by changing the feedrate specified in the program. (See Programming II-5.2)

Feed rate specified by program : 100 mm/min.

Tool

Feed rate after feed rate override (20%) : 20 mm/min.

Workpiece

- 19 -

Fig 1.4 (b) Feedrate Override

1.GENERAL OERATION B-63784EN-1/01

- Single block

Each time the cycle start button is pressed, one block of a program is executed, then the tool stops. A program is checked by executing it on a block-by-block basis. (See Section II-5.3.)

Cycle start

Cycle start Cycle start

Tool

Cycle start

Workpiece

StopStop

Stop

Fig.1.4 (c) Single Block

- 20 -

B-63784EN-1/01 OERATION 1.GENERAL

1.4.2

How to View the Position Display Change without Running the Machine

Explanations

- Machine lock

- Auxiliary function lock

The machine tool does not move, and only the position coordinates are updated.

MDI

Tool

Workpiece

The tool remains stopped, and only the positional displays of the axes change.

Fig 1.4 (d) Machine Lock

Y Z

When automatic running is placed into the auxiliary function lock mode during the machine lock mode (See Sections II-5.1), all auxiliary functions (spindle rotation, tool replacement, coolant on/off, etc.) are disabled. (See Section II-5.1)

- 21 -

1.GENERAL OERATION B-63784EN-1/01

1.5 EDITING A PART PROGRAM

After a created program is once registered in memory, it can be corrected or modified from the MDI panel (See Section II-8). This operation can be executed using the part program storage/edit function.

Program registration

CNC

Program correction or modification

Tape reader

CNC tape (program)

Fig.1.5 (a) Part Program Editing

MDI

CNC

- 22 -

B-63784EN-1/01 OERATION 1.GENERAL

1.6 DISPLAYING AND SETTING DATA

The operator can display or change a value stored in CNC internal memory by key operation on the MDI screen (See II-9).

Data setting

Data display

Screen Keys

MDI

CNC memory

Fig.1.6 (a) Displaying and Setting Data

Explanations

- Offset value

Screen

MDI

Fig.1.6 (b) Displaying and Setting Offset Values

Setting

Display

Geometry compensation

Tool compensation number1 12.3 25.0 Tool compensation 20.0 40.0 number2

Tool compensation . . . . . .

number3

. . . . . . . . . . . . . . .

CNC memory

Wear compensation

The tool has the tool dimension (length, diameter). When a workpiece is machined, the tool movement value depends on the tool dimensions. By setting tool dimension data in CNC memory beforehand, automatically generates tool routes that permit any tool to cut the workpiece specified by the program. Tool dimension data is called the offset value (See Section II-9.1).

- 23 -

1.GENERAL OERATION B-63784EN-1/01

1st tool path

Ma ch in ed shape

2nd tool path

Offset value of the 1s t tool

Offset value of the 2nd tool

Fig.1.6 (c) Offset Value

- Displaying and setting operator's setting data

Apart from parameters, there is data that is set by the operator in operation. This data causes machine characteristics to change. For example, the following data can be set:

- Inch/Metric switching

- Selection of I/O devices

- Mirror image cutting on/off The above data is called setting data (See Section II-9.3).

Setting data

Inch/Metric switching

Selection of I/O device

Mirror image ON/OFF setting

: : :

CNC Memory

Operational characteristics

utomatic

operation

Movement of the machine

Screen Keys

MDI panel

Settin

Displaying

Program

Fig.1.6 (d) Displaying and Setting Operator's setting data

- 24 -

B-63784EN-1/01 OERATION 1.GENERAL

- Displaying and setting parameters

The CNC functions have versatility in order to take action in characteristics of various machines. For example, CNC can specify the following:

- Rapid traverse rate of each axis

- Whether increment system is based on metric system or inch system.

- How to set command multiply/detect multiply (CMR/DMR)

Data to make the above specification is called parameters (See Section II-9.3). Parameters differ depending on machine tool.

Parameter

Rapid traverse rate Position control Reference position return Backlash compensation data Pitch error compensation data

: : :

Screen Keys

MDI

Setting

Display

CNC memory

Operational characteristics

Program

Fig.1.6 (e) Displaying and setting parameters

utomatic

operation

Movement of the machine

- 25 -

1.GENERAL OERATION B-63784EN-1/01

- Data protection key

A key called the data protection key can be defined. It is used to prevent part programs, offset values, parameters, and setting data from being registered, modified, or deleted erroneously. Refer to the relevant manual published by the machine tool builder for details.

Data Setting

Screen

MDI

Keys

Protection Key

Registration / modification inhibition

Program Offset value Parameters Setting data

CNC memory

Fig.1.6 (f) Data Protection Key

Signal

Machine operator's panel

Data protection key

- 26 -

B-63784EN-1/01 OERATION 1.GENERAL

1.7 DISPLAY

1.7.1 Program Display

The contents of the currently active program are displayed. In addition, the programs scheduled next and the program list are displayed.(See Section II-10.1)

Active sequence number

Active program number

Program CONTEN

The cursor indicates the currently executed location

Fig.1.7 (a) Currently executed program

- 27 -

1.GENERAL OERATION B-63784EN-1/01

Fig.1.7 (b) Program list

- 28 -

B-63784EN-1/01 OERATION 1.GENERAL

1.7.2 Current Position Display

The current position of the tool is displayed with the coordinate values. The distance from the current position to the target position can also be displayed. (See Section II-10.5)

Workpiece coordinate system

- 29 -

1.GENERAL OERATION B-63784EN-1/01

1.7.3 Operator Message Display

Messages stored to memory are displayed when the operator must be instructed during machining. (Refer to II-10.6)

1.7.4 Alarm Display

"Load t he workpi ece."

CRT di spl ay

Me m o r y

Message 1

Message displ ay number

Message 2

Message 3

When a trouble occurs during operation, error code and alarm message are displayed on the screen. (See Section II-10.7) See PROGRAMMING Appendix F for the list of error codes and their meanings.

- 30 -

B-63784EN-1/01 OERATION 1.GENERAL

1.7.5 Parts Count Display, Run Time Display

When this option is selected, five types of run time and number of parts are displayed on the screen. (See Section II-10.10)

- 31 -

1.GENERAL OERATION B-63784EN-1/01

1.7.6 Graphic Display

Programmed tool movement can be displayed on the following planes: (See Section II-10.8)

1) XY plane

2) YZ plane

3) XZ plane

4) Three dimensional display

(1)

Display on the XY plane

Display on the XZ plane

Fig. 1.7 (c) Graphic display

(2)

Display on the YZ plane

(4)(3)

Three dimensional display (isometric)

- 32 -

B-63784EN-1/01 OERATION 1.GENERAL

1.8 DATA INPUT/OUTPUT

Programs, offset values, parameters, etc. input in CNC memory can be output to paper tape, cassette, or a floppy disk for saving. After once output to a medium, the data can be input into CNC memory. (See II-

12.)

FANUC Floppy FANUC Floppy cassette

Cassette

Memory

Program

Offset

Parameters

: : :

CNC

Reader/puncher interface

Fig.1.8 (a) Data Output

SYSTEM P

utomatic programming

system

Memory card adapter (incorporated CNC)

Floppy disk

Memory card

- 33 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2 OPERATIONAL DEVICES

The available operational devices include the setting and display unit attached to the CNC, the machine operator's panel, and external input/output devices such as a PPR, Handy File, Floppy Cassette, and FA Card.

- 34 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.1 SETTING AND DISPLAY UNITS

The setting and display units are shown in Subsections II-2.1.1 to II-

2.1.3.

9.5"/10.4" LCD unit ................................................................ II-2.1.1

MDI unit..................................................................................II-2.1.2

MDI unit (full-keyboard) ........................................................II-2.1.3

- 35 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.1.1 9.5"/10.4" LCD Unit

LCD units are following three kinds.

- 9.5-inch monochrome (with graphic display)

- 9.5-inch monochrome (without graphic display)

- 10.4-inch monochrome (with graphic display)

NOTE

The LCD brightness of the 9.5-inch monochrome LCD unit with or without graphic display is lowered at low ambient temperatures. (Particularly, the LCD screen is dark immediately after power-up.) This is a characteristic of the LCD, and not a failure. As the ambient temperature rises, the LCD screen becomes brighter.

- 36 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

AK@

2.1.2 MDI Unit

Help key

Shift key

ResetT key

O(N)GEP

RESET

XUYVZWQ

I,J

HELP

M#S=T*L

F[D]H&B

SHIFT

PAG E

Page change keys

ddress/numeric keys

8 9

5 64

EOB

POS PROG

SYSTEM MESSAGE GRAPH

Function key

Cursor keys

CAN

OFFSET

SETTING

ALTER

INSERT

DELETE

INPUT

CUSTOM

Edit key

Cancel (CAN) key

Input key

- 37 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.1.3 MDI Unit (Full-keyboard)

Rest kry

ddress/numeric

keys

Shift key Help key

RESET

I J

R S

!B"

8 9

5 64

:L;

T U

D#E$F%G

MSPN O?P

V[W]X(Y

ALTER

SHIFT

CALC

INSERT

HELP

CAN

DELETE

EOB

INPUT

POS PROG

SYSTEM MESSAGE GRAPH

PAG E

OFFSET

SETTING

)

CUSTOM

Function keys

Page change keys

Cursor kys

Edit keys

Input keyCancel (CAN) key

- 38 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.1.4 MDI Unit (Main Panel A/B) for Machine Operator's Panel

The following MDI unit for machine operator's panel can be used.

Reset key

Address/numeric keys

Shift key

Function keys

Page change key

Help key

Edit keys

- 39 -

Input key

Cancel key

Cursor keys

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

RESET

2.2 EXPLANATION OF THE KEYBOARD

Table2.2 (a) Explanation of the MDI keyboard

Number Name Explanation

1 RESET key Press this key to reset the CNC, to cancel an alarm, etc.

2 HELP key Press this button to use the help function when uncertain about the operation of an MDI

key (help function).

Soft keys

4 Address and numeric

keys

)

The soft keys have various functions, according to the Applications. The soft key functions are displayed at the bottom of the screen. Press the inside of the rectangle area of the soft key button on the screen, when the CNC with the touch panel function is used. The button of the soft key becomes dented and indicated. And, the same operation treatment as the present soft key is done. Press these keys to input alphabetic, numeric, and other characters.

5 SHIFT key Some keys have two characters on their keytop. Pressing the <SHIFT> key switches

the characters. Special character # is displayed on the screen when a character

SHIFT

indicated at the bottom right corner on the keytop can be entered.

6 INPUT key When an address or a numerical key is pressed, the data is input to the buffer, and it is

displayed on the screen. To copy the data in the key input buffer to the offset register,

INPUT

etc., press the key. This key is equivalent to the [INPUT] key of the soft keys, and either can be pressed to produce the same result.

7 Cancel key

CAN

Press this key to delete the last character or symbol input to the key input buffer. When the key input buffer displays

>N001X100Z_ and the cancel <CAN> key is pressed, Z is canceled and >N001X100_

is displayed.

8 Program edit keys Press these keys when editing the program.

ALTER

: Alteration

ALTER INSERT

9 Function keys

DELETE

INSERT

: Insertion

DELETE

: Deletion

Press theses keys to switch display screens for each function. See lll - 2.5 for details of the function keys.

POS PROG

- - -

- 40 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

Table2.2 (a) Explanation of the MDI keyboard

Number Name Explanation

10 Cursor move keys There are four different cursor move keys.

: This key is used to move the cursor to the right or in the forward

direction. The cursor is moved in short units in the forward direction.

: This key is used to move the cursor to the left or in the reverse direction.

The cursor is moved in short units in the reverse direction.

: This key is used to move the cursor in a downward or forward direction.

The cursor is moved in large units in the forward direction.

: This key is used to move the cursor in an upward or reverse direction.

The cursor is moved in large units in the reverse direction.

11 Page change keys Two kinds of page change keys are described below.

PAGE

: This key is used to changeover the page on the screen in the forward direction.

: This key is used to changeover the page on the screen in the reverse direction.

- 41 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.3 OPERATION SCREEN DISPLAY

The operation screens used in the CNC are classified into the following levels and managed hierarchically:

- Function

- Chapter

Function

Chapter

Function 1

Operation screen 1 of function 1

Operation screen 2 of function 1

Operation screen 1 of function 2

Function 2

Operation screen 2 of function 2

To display a desired operation screen, select a function then chapter. A function can be selected by using one of the two methods explained below. A desired function can be selected using either method.

- Using a function key on the MDI panel to select a function When a function is selected using this method, the soft key display automatically changes to the chapter selection menu.

- Selecting a function displayed on a soft key When a function is selected using this method, the soft key display does not automatically change to the chapter selection menu. To change the soft key display to the chapter selection menu, select the chapter key.

To select a chapter, use one of the following methods:

- Pressing a function key on the MDI panel several times repeatedly Repeatedly pressing a function key displays the chapters of the corresponding function sequentially. After the last chapter is selected, the first chapter is selected again. This method is useful when you want to display all the chapters of a function.

- Selecting from the chapters displayed on the soft keys Select from the chapter selection menu displayed on the soft keys. This method is useful when you determine the chapter of a target operation screen.

- 42 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.4

OPERATIONS SUPPORTED BY EACH OPERATION SCREEN

The operation screens support a wide range of operations. On the program screen, for example, you can select and search for a desired program. On the setting screens, operations such as altering the settings and outputting the setting data to external input/output devices are possible. The operations that can be performed vary depending on the operation screens. A desired operation can be selected and executed using an operation menu key (soft key) from an operation screen.

Function

Chapter

Operation

Operation screen 1 of function 1

Operation 1

Operation 2

Function 1

Operation screen 2 of function 1

Operation 1

Operation 2

Operation screen 1 of function 2

Operation 1

Operation 2

Function 2

Operation screen 2 of function 2

Operation 1

Operation 2

- 43 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.5 FUNCTION KEYS AND SOFT KEYS

2.5.1 General Screen Operations

1 Press a function key on the MDI panel. The chapter selection soft

keys that belong to the selected function appear.

POS

SYSTEM

PROG

MESSAGE

OFFSET

SETTING

GRAPH

CUSTOM

2 Press one of the chapter selection soft keys. The screen for the

selected chapter appears.

3 To perform operations on the displayed screen of the chapter,

press the operation menu key.

For example, pressing the key displays the chapter

PROG

selection soft keys shown below. When these soft keys are displayed for the first time, the first chapter is selected. (In this example, "TEXT" is selected.) To display the operation selection menu for this screen, press the operation menu key located at the right end.

operation menu key

4 To redisplay the chapter menu keys for chapter selection while the

operation selection menu is being displayed, press the chapter key.

chapter key

The general screen display procedure is explained above. However, the actual display procedure varies from one screen to another. For details, see the description of the individual operations.

- 44 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.5.2 Function Keys

Function keys are provided to select the type of screen to be displayed. The following function keys are provided on the MDI panel:

POS

PROG

OFFSET

SETTING

SYSTEM

MESSAGE

GRAPH

Press this key to display the position screen.

Press this key to display the program screen.

Press this key to display the offset/setting screen.

Press this key to display the system screen.

Press this key to display the message screen.

Press this key to display the graphics screen.

- 45 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.5.3 Soft Keys

Instead of the function keys, soft keys can also be used to select the type of screen to be displayed. In addition, soft keys are used for actual operations. The subsequent sections show a function menu and chapter selection menus.

NOTE

The soft keys explained below are not always displayed. Some of the soft keys do not appear depending on the set options.

2.5.4 Function Selection Keys

To select a function with the soft key, press the function selection menu key to change the soft keys to the function selection keys, then press the desired function selection key. Functions can be selected in any mode. Detailed function selection is performed with the chapter selection keys. The following function selection keys are provided:

Function menu key

Function key

NO.

(MDI panel)

(1) POSITION

(2) PROGRAM

(3) OFFSET/SETTING

(4) SYSTEM

(5) MESSAGE

(6) GRAPHIC

POS

PROG

OFFSET

SETTING

SYSTEM

MESSAGE

GRAPH

Function selection key

(soft key)

Explanation

Current-position information screens indicating absolute coordinates, machine coordinates, relative coordinates, remaining amounts of travel, and so forth can be selected. The part program display screen, program check screen, and so forth can be selected.

The tool offset screen, workpiece origin offset screen, and so forth can be selected.

The parameter screen, diagnosis screen, PMC screen, and so forth can be selected.

Alarm message and operator message screens can be selected.

Graphics screens can be selected.

- 46 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.5.5 Chapter selection keys

The function selection keys are used to select large items (functions). Each of them is further divided into smaller items (chapters). These items (chapters) are selected using chapter selection keys. To select a chapter, press the chapter key to display chapter selection keys on the soft keys first, then press the target chapter selection key. Change from one chapter to another can also be performed by pressing a function hard key several times repeatedly. The following sections list the chapters contained in each function.

2.5.5.1 Position

Function key on the MDI panel Soft keys

POS

POSITION CHAPTER

(1) (2) (3) (4) (5) (6) (7) (8) (9) (10)

NO. Chapter menu Explanation

(1) OVERALL Selects the overall position display screen. (2) RELATIVE Selects the relative position display screen. (3) ABSOLUTE Selects the position display screen based on the

workpiece coordinate system.

(4) MACHINE Selects the position display screen based on the

machine coordinate system.

(5) MANUAL OVRLAP Selects the operation screen for performing

manual handle feed interrupt operation.

(6) BLOCK RESTRT Selects the operation screen for restarting

operation from a block in which the previous operation was interrupted.

(7) PRGRAM RESTRT Selects the operation screen for restarting the

interrupted program operation.

(8) TOOL HEAD Displays the absolute coordinates and actual

feedrate of the tool tip during handle feed in the longitudinal direction of the tool, handle feed in the transverse direction of the tool, and rotational handle feed around the tool tip.

(9) HANDLE PULSE Displays the handle pulse interrupt amount for

performing three-dimensional handle feed.

- 47 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.5.5.2 Program

Function key on the MDI panel Soft keys

PROG PROGRAM

CHAPTER

(1) (2) (3) (4) (5) (6) (7) (8) (9) (10)

(11) (12) (13) (14) (15) (16) (17) (18) (19)

No. Chapter menu Explanation

(1) TEXT Selects the screen for displaying the contents of a

currently selected part program.

(2) DIR. MEMORY Selects the screen for displaying a list of currently

registered part programs.

(3) HDD DIR. Selects the screen for displaying a list of files saved on

the hard disk of the data server.

(4) HOST DIR. Selects the screen for displaying a list of files on the host

computer.

(5) CHANGE

HOST

(6) CHECK Selects the screen for displaying a program, positions,

(7) LAST Selects the screen for displaying the values specified in

(8) ACTIVE Selects the screen for displaying the values specified in

(13) POS.DATA Selects the screen for displaying information about

Selects the screen for changing to connect the host computer.

modal information, and so forth at the same time.

the block immediately preceding the block currently being executed, and modal values such as G code and F code which were specified in the blocks up to the preceding block.

the block currently being executed, and modal values such as G code and F code which were specified in the blocks up to the current block.

position compensation.

- 48 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.5.5.3 Offset/Setting

Function key on the MDI panel

OFFSET SETIN G

OFFSET

Soft keys

CHAPTER

(1) (2) (3) (4) (5) (6) (7) (8) (9) (10)

(11) (12) (13) (14) (15) (16) (17) (18) (19)

(21) (22) (23) (24) (25) (26) (27) (28) (29)

No. Chapter menu Explanation

(1) TOOL Selects the screen for setting tool offset values.

WORK

(2)

OFFSET

(3) MEASURE_TL Selects the screen for tool length measurement.

SETTING

(4)

PARAMETER

(5) TIMER

(6) RS232C

(7) MEMCARD Selects the screen for memory card operation (8) MACRO VAR. Selects the screen for setting macro variables.

(9) TOOL LIFE

T CODE

(11)

OFFSET (12) FOFS Selects the fixture offset screen. (13) DOFS Selects the dynamic tool offset screen. (14) SU&NUTATR Selects the SU&NUTATR offset screen.

(15) COM. SETING

OPERAT (16)

PANEL

MENU (17)

SWITCH

(29) DISP COLOR

Selects the screen for setting workpiece origin offset values.

Selects the screen for specifying setting parameters.

Selects the screen for displaying information about the number of machined parts and operation time. Selects the screen for operating devices connected to the RS-232C interface

Selects the screen for making settings related to tool life management. Selects the screen for setting a tool number, pot number, and value for tool offset by tool number.

Selects the screen for making RS-232C and RS-422 settings. Selects the screen for using part of the operation switches on the machine operator's panel as soft switches. Selects the screen for setting part of the switch signals input from the machine for CNC operation. Selects the screen for adjusting tbrightness of the monochrome LCD.

- 49 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.5.5.4 System

Function key on the MDI panel

SYSTEM

Soft keys

CHAPTER

(1) (2) (3) (4) (5) (6) (7) (8) (9) (10)

(11) (12) (13) (14) (15) (16) (17) (18) (19)

(21) (22) (23) (24) (25) (26) (27) (28) (29)

No. Chapter menu Explanation

(1) PARAMETER Selects the screen for parameter setting. (2) PITCH ERROR Selects the screen for pitch error compensation setting. (3) DIAGNOSIS Selects the screen for displaying the CNC status information. (4) DI/DO MONITOR Selects the screen for displaying the signal status. (5) PERIOD

MAINTE (6) MAINTE INFO Selects the screen for setting maintenance information. (7) SYSTEM

CONFIG (8) PMC Selects the screen related to the PMC.

(11) WAVE DIAGNS Selects the screen for graphically displaying data such as a

(12) SERVO Selects the screen for making servo settings. (13) SPINDLE Selects the screen for making spindle settings. (14) HPCC Selects the screen for setting high-precision contour control. (17) FSSB Selects the screen for setting the high-speed serial servo bus

(18) VOLUMETRIC Selects the screen for setting three-dimensional error

(19) DISPLY

MEMORY

(23) ETHERNET Selects the screen for setting related to ethernet board. (24) DATA SERVER Selects the screen for Data server maintenance and setting. (25) ALARM

HISTORY

(26) OPERAT

HISTORY

(27) SYSTEM LOG Selects the screen for displaying the descriptions of system

(28) TOUCH PANEL Selects the screen for setting the touch panel.

Select the screen for setting those items that require routine maintenance.

Selects the screen for displaying the current system status.

servo positional deviation, torque, and machine signals.

(FSSB: FANUC Serial Servo Bus).

compensation values. Selects the screen for displaying the current CNC memory contents

Selects the screen for displaying the descriptions of alarms issued before Selects the screen for displaying a history of keystrokes.

alarms issued before.

- 50 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.5.5.5 Messages

2.5.5.6 Drawing

Function key on the MDI panel

MESSAGE

Soft keys

CHAPTER

(1) (2) (3) (4) (5) (6) (7) (8) (9) (10)

No. Chapter menu Explanation

(1) ALARM Selects the alarm message screen. (2) OPERATOR Selects the operator message screen. (3) ETHERNET Selects the screen for displaying the log related to

Ethernet board.

Function key on the MDI panel

GRAPH

GRAPHIC

Soft keys

CHAPTER

(1) (2) (3) (4) (5) (6) (7) (8) (9) (10)

No. Chapter menu Explanation

(1) Tool Path Selects the screen for graphic display of the tool path. (2) GRAPH

PARAM

Selects the screen for setting graphic display of the tool path.

- 51 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.5.6 Key Input and Input Buffer

2.5.6.1 Inserting characters

When an address and a numerical key are pressed, the character corresponding to that key is input once into the key input buffer. The contents of the key input buffer is displayed at the bottom of the screen. A "_" is displayed at the end of the key input data indicating the input position of the next character.

Fig.2.5.6 (a) Key Input Buffer Display

To input the lower character of the keys that have two characters inscribed on them, first press the <SHIFT> key and then the key in question. When the <SHIFT> key is pressed, "_" indicating the next character input position changes to "~". Now lowercase characters can be entered (shift state). When a character is input in shift status the shift status is canceled. Furthermore, if the <SHIFT> key is pressed in shift status, the shift status is canceled.

Example

Inserting G90 after N001 when "N001X100.0Y200.0F100.0;_" is displayed as the contents of the key input buffer:

- Press cursor key ↑ to move the cursor to the following position:

N001_X100.0Y200.0F100.0;

- Key in G90. N001G90_X100.0Y200.0F100.0;

- Press cursor key ↓ to move the cursor to the following position: N001G90X100.0Y200.0F100.0;_

- 52 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.5.6.2 Deleting characters

Move the cursor to a position next to a character you want to

Example

delete, then press the key.

When the key is pressed while the shift button is held

CAN

down, the contents of the key input buffer are all deleted.

Deleting Y200.0 when "N001X100.0Y200.0F100.0;_" is displayed as the contents of the key input buffer:

- Press cursor key <↑> to move the cursor to the following position: N001X100.0Y200.0_F100.0;

- Press the <CAN> key six times. N001X100.0_F100.0;

- Press the cursor key <↓> to move the cursor to the following

position:

N001X100.0F100.0;_

- 53 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.5.7 Warning Messages

After a character or number has been input from the MDI

panel, a data check is executed when key or a soft key is pressed. In the case of incorrect input data or the wrong operation a flashing warning message will be displayed on the status display line.

Warning message display

Display of key input buffer

Soft key display

Fig. 2.5.7 Warning message display

Table2.5.7 Warning Messages

Warning message Content

FORMAT ERROR The format is incorrect. WRITE PROTECT Key input is invalid because of data protect key or

the parameter is not write enabled. DATA IS OUT OF RANGE The input value exceeds the permitted range. TOO MANY DIGITS The input value exceeds the permitted number of

digits. WRONG MODE An appropriate mode is not selected.

EDIT REJECTED It is not possible to edit in the current CNC

status.

- 54 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.6 LANGUAGE SELECTION

The Japanese, English, German, French, Italian, Spanish, Swedish, and Chinese are prepared as display languages. Select the language to be displayed by parameters.

Fig. 2.6 (a) Example of operation screen : JAPANESE

Fig. 2.6 (b) Example of operation screen : ENGLISH

- 55 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.7 EXTERNAL I/O DEVICES

Three types of external input/output devices are available. This section outlines each device. For details on these devices, refer to the corresponding manuals listed below.

Table 2.7(a) External I/O device

Max.

Device name Usage

FANUC Handy File

FANUC Floppy Cassette FANUC FA Card

Easy-to-use, multi function input/output device. It is designed for FA equipment and uses floppy disks. Input/output device. Uses floppy disks. 2500m B-66040E

Compact input/output device. Uses FA cards.

Storage

capacity

3600m B-61834E

160m B-61274E

The following data can be input/output to or from external input/output devices:

1. Programs

2. Offset data

3. Parameters

4. Custom macro common variables For how data is input and output, see II-12.

Reference

manual

- 56 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

Parameter

Before an external input/output device can be used, parameters must be set as follows.

CNC

MAIN CPU BOARD

Channel 1

JD5A

Reader puncher

I/O CHANNEL=1 I/O CHANNEL=2

Channel 2

JD5B

Reader puncher

DISPLAY UNIT

Channel 3

JD36A

RS-232-C

Host computer

I/O CHANNEL=3 I/O CHANNEL=13

Channel 13

JD6A

RS-422RS-232-CRS-232-C

Host computer

Each external input/output device is temporarily assigned a device number from 1 to 6. When four external input/output devices are used, for example, a device number from 1 to 4 is assigned to each device. After the device numbers are assigned to the external input/output devices, their specifications are set in parameter Nos. 5110 to 5162. The numbers of the external input/output devices attached to channels 1, 2, 3, and 13 are set in parameter Nos. 5001, 5002, 5003, and 5013.

Foreground

Background

Channels used by input/output devices

Channel No.

0020

0021

0022

0023

Parameter number

- 57 -

5001

5002

5003

5013

Device number used for each channel

Device No.

5110

5111

5112

5120

5121

5122

3 : 4 : 5 :

5160

5161

5162

Device specification

Number of stop bits

Baud rate

Device specification

Number of stop bits

Baud rate

Device specification

Number of stop bits

Baud rate

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.7.1 FANUC Handy File

The Handy File is an easy-to-use, multi function floppy disk input/output device designed for FA equipment. By operating the Handy File directly or remotely from a unit connected to the Handy File, programs can be transferred and edited. The Handy File uses 3.5-inch floppy disks. One or more programs (up to 1.44M bytes, which is equivalent to the memory capacity of 3600-m paper tape) can be stored on one floppy disk.

RS-422 Interface

RS-232-C Interface

FANUC

Handy File

2.7.2 FANUC Floppy Cassette

When the Floppy Cassette is connected to the CNC, machining programs stored in the CNC can be saved on a Floppy Cassette, and machining programs saved in the Floppy Cassette can be transferred to the CNC.

RS-232-C o RS-422 Interface (Punch panel, etc.)

FAN

RS-232-C Interface (Punch panel, etc.)

POWER

OFF

- 58 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.7.3 FANUC FA Card

An FA Card is a memory card used as an input medium in the FA field. It is compact, but has a large memory capacity with high reliability, and requires no special maintenance. When an FA Card is connected to the CNC via the card adapter, machining programs stored in the CNC can be transferred to and saved in an FA Card. Machining programs stored on an FA Card can also be transferred to the CNC.

RS-232-C Interface (Punch panel, etc.)

READY

READ

WRITE

ALARM

RESET

- 59 -

2.OPERATIONAL DEVICES OPERATION B-63784EN-1/01

2.8 POWER ON/OFF

2.8.1 Turning on the Power

Procedure of turning on the power

Procedure

1 Check that the appearance of the CNC machine tool is normal.

(For example, check that front door and rear door are closed.)

2 Turn on the power according to the manual issued by the machine

tool builder.

3 After the power is turned on, check that the position screen is

displayed. An alarm screen is displayed if an alarm occurs upon power-on. If the screen shown in Maintenance Manual (Sec. 7.11) is displayed, a system failure may have occurred.

Screen & Position display

4 Check that the fan motor is rotating.

WARNING

Until the positional or alarm screen is displayed at the power on, do not touch them. Some keys are used for the maintenance or special operation purpose. When they are pressed, unexpected operation may be caused.

- 60 -

B-63784EN-1/01 OPERATION 2.OPERATIONAL DEVICES

2.8.2 Power Disconnection

Power Disconnection

Procedure

1 Check that the LED indicating the cycle start is off on the

operator's panel. 2 Check that all movable parts of the CNC machine tool is stopping. 3 If an external input/output device such as the Handy File is

connected to the CNC, turn off the external input/output device. 4 Continue to press the POWER OFF pushbutton for about 5

seconds. 5 Refer to the machine tool builder's manual for turning off the

power to the machine.

CAUTION

In the cable connecting the input/output unit and RS-232-C interface, the SG signal and each signal must be paired as shown in the figure below.

- 61 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

3 MANUAL OPERATION

MANUAL OPERATION are as follows :

3.1 Manual reference position return

3.2 Jog feed

3.3 Incremental feed

3.4 Manual handle feed

3.5 Manual feed in a specified direction

3.6 Manual numeric command

3.7 Manual absolute on and off

3.8 Effect of manual intervention

3.9 Three-dimensional handle feed

3.10 Changing tool length compensation in the longitudinal

direction of the tool

3.11 Tool holder offset

3.12 Rotary axis origin compensation and rotary axis offset

3.13 Precautions during 3-dimensional handle feed

3.14 Displaying the coordinates of the tool tip

3.15 Displaying pulse values and amount of movement by manual

interrupt

3.16 Manual interruption function for three-dimensional coordinate

conversion

- 62 -

B-63784EN-1/01 OPERATION 3.MANUAL OPERATION

AXIS

3.1 MANUAL REFERENCE POSITION RETURN

The tool is returned to the reference position as follows : The tool is moved in the direction specified in parameter ZMI (bit 5 of No. 1006) for each axis with the reference position return switch on the machine operator's panel. The tool moves to the deceleration point at the rapid traverse rate, then moves to the reference position at the FL speed. The rapid traverse rate and FL speed are specified in parameters (No. 1420,1421, and 1425). Rapid traverse override is effective during rapid traverse. When the tool has returned to the reference position, the reference position return completion LED goes on.

Procedure

EDIT

Deceleration

Rapid traverse motion

Rapid traverse rate

(rapid traverse override is effective)

Procedure for Manual Reference Position Return

MODE

REMOTE

MEMORY

ZERO RETURN

RAPID TRAVERSE OVERRIDE (%)

50 10025

DIRECTION

+C +Z +Y

RAPID

MDI

TEACHJOGHANDLE

+X-X

1 Press the reference position return switch, one of the mode

selection switches. 2 To decrease the feedrate, press a rapid traverse override switch.

When the tool has returned to the reference position, the reference

position return completion LED goes on. 3 Press the feed axis and direction selection switch corresponding to

the axis and direction for reference position return. Continue pressing

the switch until the tool returns to the reference position. The tool

moves to the deceleration point at the rapid traverse rate, then moves

to the reference position at the FL speed set in a parameter. 4 Perform the same operations for other axes, if necessary.

The above is an example. Refer to the appropriate manual provided by the machine tool builder for the actual operations.

point

Reference position

Decelerated motion

FL speed

-Y -Z

PROGRAM

STOP

M30

ZERO POSITION

Y Z

M02/

MANU

SPINDLE

ABS

X2 Y2 Z2

ORI TAP

ATC

READY

MIRRROR IMAGE

Y Z

NC?MC?

- 63 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

Restrictions

- Moving the tool again

Once the REFERENCE POSITION RETURN COMPLETION

LED lights at the completion of reference position return, the tool

does not move unless the REFERENCE POSITION RETURN

switch is turned off.

- Reference position return completion LED

The REFERENCE POSITION RETURN COMPLETION LED is

extinguished by either of the following operations:

- Moving from the reference position.

- Entering an emergency stop state.

- The distance to return to reference position

For the distance (Not in the deceleration condition) to return the

tool to the reference position, refer to the manual issued by the

machine tool builder.

- 64 -

B-63784EN-1/01 OPERATION 3.MANUAL OPERATION

AXIS

3.2 JOG FEED

In the jog mode, pressing a feed axis and direction selection switch on the machine operator's panel continuously moves the tool along the selected axis in the selected direction. The jog feedrate is specified in a parameter (No.1423) The jog feedrate can be adjusted with the jog feedrate override dial. Pressing the rapid traverse switch moves the tool at the rapid traverse feedrate (No.1420) regardless of the position of the jog feedrate override dial. This function is called the manual rapid traverse.

HANDLE

MODE

JOG

REMOTE MDIMEMORYEDIT

ZERO RETURN

Procedure

+C +Z +Y

Procedure for JOG feed

DIRECTION

+X-X

RAPID

-Y -Z

While a switch is pressed the tool moves in the direction specified by the switch.

1 Press the jog switch, one of the mode selection switches. 2 Press the feed axis and direction selection switch corresponding to

the axis and direction the tool is to be moved. While the switch is

pressed, the tool moves at the feedrate specified in a parameter

(No. 1423). The tool stops when the switch is released. 3 The jog feedrate can be adjusted with the jog feedrate override

dial. 4 Pressing the rapid traverse switch while pressing a feed axis and

direction selection switch moves the tool at the rapid traverse rate while the rapid traverse switch is pressed. Rapid traverse override by the rapid traverse override switches is effective during rapid traverse.

- 65 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

The above is an example. Refer to the appropriate manual provided by the machine tool builder for the actual operations.

0 2000

JOG FEED RATE OVERRIDE

RAPID TRAVERSE OVERRIDE (%)

50 100

Limitations

- Acceleration/deceleration for rapid traverse

Feedrate, time constant and method of automatic acceleration/

deceleration for manual rapid traverse are the same as G00 in

programmed command.

- Change of modes

Changing the mode to the jog mode while pressing a feed axis and

direction selection switch does not enable jog feed. To enable jog

feed, enter the jog mode first, then press a feed axis and direction

selection switch.

- Rapid traverse before reference position return

When the stored stroke limit option is supported, if reference

position return is not performed after the power is turned ON,

pressing the RAPID TRAVERSE button does not actuate rapid

traverse on the axis to which the reference position return function

is programmed; the feedrate remains at the jog feedrate. As the

stored stroke limit is effective until reference position return is

performed, axis movement at the rapid traverse rate up to the

stroke end is prevented. This function can be disabled by setting

bit 2 (RPD) of parameter No.1400.

- 66 -

B-63784EN-1/01 OPERATION 3.MANUAL OPERATION

AXIS

3.3 INCREMENTAL FEED

In the incremental mode(s), pressing a feed axis and direction selection switch on the machine operator's panel moves the tool one step along the selected axis in the selected direction.

Procedure

X100

X10

Procedure for Incremental Feed

1 Press the INC switch, one of the mode selection switches.

X1000

X10000

X100000

DIRECTION

+C +Z +Y

2 Select the distance to be moved for each step with the

magnification dial. 3 Press the feed axis and direction selection switch corresponding to

the axis and direction the tool is to be moved. Each time a switch

is pressed, the tool moves one step. The feedrate is the same as the

jog feedrate. 4 Pressing the rapid traverse switch while pressing a feed axis and

direction selection switch moves the tool at the rapid traverse rate. Rapid traverse override by the rapid traverse override switch is effective during rapid traverse.

Tool

Each time a switch is pressed, the tool moves one step in the direction specified by the switch.

RAPID

-Y -Z

+X-X

The above is an example. Refer to the appropriate manual provided by the machine tool builder for the actual operations.

- 67 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

3.4 MANUAL HANDLE FEED

In the handle mode, the tool can be minutely moved by rotating the manual pulse generator on the machine operator's panel. Select the axis along which the tool is to be moved with the handle feed axis selection switches. The minimum distance the tool is moved when the manual pulse generator is rotated by one graduation is equal to the least input increment. Or the distance the tool is moved when the manual pulse generator is rotated by one graduation can be magnified by 10 times or by one of the two magnifications specified by parameters (No. 1414 and 1418).

Procedure

EDIT

HANDLE

Manual pulse generator

Procedure for Manual Handle Feed

1 Press the HANDLE switch, one of the mode selection switches.

MODE

MEMORY

JOG

REMOTE

ZERO RETURN

MDI

TEACH

2 Select the axis along which the tool is to be moved by pressing a

handle feed axis selection switch. 3 Select the magnification for the distance the tool is to be moved by

pressing a handle feed magnification switch. 4 Move the tool along the selected axis by rotating the handle.

Rotating the handle 360 degrees moves the tool the distance equivalent to 100 graduations.

The above is an example. Refer to the appropriate manual provided by the machine tool builder for the actual operations.

Manual pulse generator

- 68 -

B-63784EN-1/01 OPERATION 3.MANUAL OPERATION

Explanation

- When a manual handle feed faster than the rapid traverse rate is specified

When a handle feed faster than the rapid traverse rate is specified, the command pulses up to the permissible flow amount set in parameter No. 1413 are accumulated in the CNC.

- Distance the tool is moved by manual handle feed

The minimum distance the tool is moved when the manual pulse generator is rotated by one gradation is equal to the least input increment. The magnification for the distance the tool is to be moved can be selected from 10 times and the two magnifications specified by parameter Nos. 1414 and 1418.

Restrictions

- Number of MPGs

Up to three manual pulse generators can be connected, one for each axis. The three manual pulse generators can be simultaneously operated.

WARNING

Rotating the handle quickly with a large magnification such as ×100 moves the tool too fast. The feedrate is clamped at the rapid traverse feedrate.

NOTE

Rotate the manual pulse generator at a rate of five rotations per second or lower. If the manual pulse generator is rotated at a rate higher than five rotations per second, the tool may not stop immediately after the handle is no longer rotated or the distance the tool moves may not match the graduations on the manual pulse generator.

- 69 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

3.5 MANUAL FEED IN A SPECIFIED DIRECTION

The tool can be manually moved in a specified direction on a specified plane. The feedrate and the direction and plane of feed can be changed at any time. Simple cutting can be manually executed on a plane.

Explanation

- Selecting a plane

Specify external signals that indicate the first and second axes of the plane on which the tool is manually moved in a specified direction.

- Specifying the direction of feed

Enter an external input signal that indicates the direction in which the tool is to be manually moved. The direction of feed can be specified in the range of 0 to 360 degrees in 1/16 degrees. The angle is specified as shown below. If an angle greater than 360 degrees is specified, the CNC unit repeatedly subtracts 360 from the angle until it falls within the range of 0 to 360 degrees. While the tool is being manually moved in the specified direction, the direction of feed can be changed as required. When the direction is changed, the position check is not executed, but the move command in the new direction is immediately executed.

- Specifying a feedrate

(Positive direction of the second axis)

90°

180°

(Positive direction of the first axis)

270°

0°

Using the dial for specifying the jog feedrate, specify the feedrate (as a tangential velocity) at which the tool is manually moved in the specified direction. Parameter No. 1411 determines the feedrate when the dial is set to the 100% position.

- 70 -

B-63784EN-1/01 OPERATION 3.MANUAL OPERATION

- Starting and stopping manual feed in the specified direction

Manual feed in the specified direction is executed while the corresponding signals are “1”. The signal that moves the tool in the specified direction and the signal that moves it in the opposite direction are used in manual feed.

NOTE

1 When the mode of manual feed in the specified

direction is selected, the tool can be moved only on the selected plane determined by the selected axes.

2 Automatic or manual operation cannot be switched

when manual feed in the specified direction is executed.

- 71 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

3.6 MANUAL NUMERIC COMMAND

The manual numeric command function allows data programmed by MDI to be executed in the jog mode. Whenever the system is ready for jog feed, a manual numeric command can be executed. The following eight functions are supported: (1) Positioning (G00) (2) Linear interpolation (G01) (3) Automatic reference position return (G28) (4) 2nd, 3rd or 4th reference position return (G30) (5) M codes (miscellaneous functions) (6) S codes (spindle functions) (7) T codes (tool functions) (8) B codes (second auxiliary function)

Procedure Manual numeric command

Procedure

1 Follow the procedure for displaying the manual numeric

command screen to display the manual numeric command screen

as follows:

2 Press the operation menu key to display the soft keys in the

operation selection menu. 3 Key in the required command using the address keys and numeric

keys on the MDI panel, and press either

soft key [ENTER] or <INPUT> to set the data.

- 72 -

B-63784EN-1/01 OPERATION 3.MANUAL OPERATION

The following data can be set:

1. G00 : Positioning

2. G01 : Linear interpolation

3. G28 : Automatic reference point return

4. G30 : 2nd, 3rd or 4th reference position return

5. M codes : Miscellaneous functions

6. S codes : Spindle functions

7. T codes : Tool functions

8. B codes : Second auxiliary functions

The set data is held in memory even if the screen or mode is changed.

NOTE

Data cannot be set when an alarm occurs.

4 Press the Cycle Start button on the machine operator's panel to

start command execution. The status is indicated as "MSTR." The automatic operation signal STL can be set to "1" (ON) by setting bit 2 (STJ) of parameter No. 2000.

5 When execution is completed, the "MSTR" status indication is

cleared from the screen, and automatic signal operation STL is

turned OFF. All set data is cleared. G codes are set to G00 or G01

according to the setting of bit 0 (G01) of parameter No. 2401.

NOTE

If the Cycle Start button is pressed while an alarm has occurred, a "START IMPOSSIBLE" warning is generated, and the entered data cannot be executed.

- 73 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

Explanation

- Positioning

The amount of travel is given as a numeric value, preceded by an address such as X, Y or Z. This is always regarded as being an incremental command, regardless of whether G90 or G91 is specified. The tool moves along each axis independently at the rapid traverse rate. Linear interpolation type positioning (when the tool path is linear) can also be performed by setting bit 4 (LRP) of parameter No. 1400.

Manual rapid traverse selection switch

OFF ON

Feedrate (parameter)

Automatic acceleration/deceler ation (parameter)

Override Manual feed override Rapid traverse override

- Linear interpolation (G01)

The amount of travel is given as a numeric value, preceded by an address such as X, Y or Z. This is always regarded as being an incremental command, regardless of whether G90 or G91 is specified. Axial movements are always performed in the incremental mode even during scaling or polar coordinate interpolation. In addition, movement is always performed in feed per minute mode, regardless of whether G94 or G95 is specified.

Jog feedrate for each axis

(No. 1423)

Exponential acceleration/

deceleration in jog feed for

each axis

(No. 1624)

Rapid traverse for each

axis (No. 1420)

Linear acceleration/

deceleration in rapid

traverse for each axis

(No. 1620)

Feedrate (parameter) Dry run speed (No. 1410)

Automatic acceleration/

deceleration (parameter)

Override Manual feed override

Exponential acceleration/

deceleration in cutting feed for each

axis (No. 1622)

NOTE

Since the feedrate is always set to the dry run feedrate, regardless of the setting of the dry run switch, the feedrate cannot be specified using F. The feedrate is clamped so that the maximum cutting feedrate, set in parameter No. 1422, is not exceeded.

- 74 -

B-63784EN-1/01 OPERATION 3.MANUAL OPERATION

- Automatic reference position return (G28)

The tool returns directly to the reference position without passing through any intermediate points, regardless of the specified amount of travel. For axes for which no move command is specified, however, a return operation is not performed.

Feedrate (parameter) Rapid traverse rate (No. 1420)

Automatic acceleration/

deceleration (parameter)

Override Rapid traverse override

deceleration in rapid traverse for each

Linear acceleration/

axis (No. 1620)

- 2nd, 3rd or 4th reference position return (G30)

The tool returns directly to the 2nd, 3rd or 4th reference position without passing through any intermediate points, regardless of the specified amount of travel. To select a reference point, specify P2, P3 or P4 in address P. If address P is omitted, a return to the 2nd reference position is performed.

Feedrate (parameter) Rapid traverse rate (No. 1420)

Automatic acceleration/

deceleration (parameter)

Override Rapid traverse override

deceleration in rapid traverse for each

Linear acceleration/

axis (No. 1620)

NOTE

The 2nd, 3rd or 4th reference position return function is optional. If this option is not selected, the warning "FORMAT ERROR" is generated, and G30 cannot be entered. If neither of P2, P3 or P4 are specified in address P when this option is selected, a "START IMPOSSIBLE" warning is generated, and the entered data cannot be executed.

- M codes (miscellaneous functions)

After address M, specify a numeric value of no more than the number of digits specified by parameter No. 2030.

NOTE

Neither subprogram calls nor custom macro calls can be performed using M codes.

- S codes (spindle functions)

After address S, specify a numeric value of no more than the number of digits specified by parameter No. 2031.

NOTE

Subprogram calls cannot be performed using S codes.

- 75 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

- T codes (tool functions)

After address T, specify a numeric value of no more than the number of digits specified by parameter No. 2032.

NOTE

Subprogram calls cannot be performed using T codes.

- B codes (second auxiliary functions)

After address B, specify a numeric value of no more than the number of digits specified by parameter No. 2033.

NOTE

Subprogram calls cannot be performed using B codes.

- Data input

(1) When addresses and numeric values of a command are types, then

soft key [INPUT] is pressed, the entered data is set. In this case,

the input key is either least input increment or calculator-type

input format according to the setting of bit 0 (DPI) of parameter

No. 2400.

The <INPUT> key on the MDI panel can be used instead of soft

key [INPUT]. (2) Commands for multiple addresses can be types successively. (3) Key entry is disabled during execution. If soft key [INPUT] or the

<INPUT> key on the MDI panel is pressed during execution, an

"EXECUTION/MODE SWITCHING IN PROGRESS" warning

is generated. (4) If input data contains an error, the following warnings may be

generated:

Warning Description

-G code other than G00, G01, G28 and G30 has been entered.

-An address other than those displayed on the manual numeric command screen has been entered.

FORMAT

ERROR

TOO MANY DIGITS A value that exceeds the following limitations has been entered:

-Address G: 2 digits

-Address P: 1 digit

-Axis address: 9 digits

-M, S, T, B: The parameter-set number of digits

NOTE

Even when the memory protection key is set, key input can be performed nevertheless.

- 76 -

B-63784EN-1/01 OPERATION 3.MANUAL OPERATION

- Erasing data

(1) When soft key [CLEAR] is pressed, followed by soft key [EXEC],

all set data is cleared. In this case, however, the G codes are set to G00 or G01 according to the setting of bit 0 (G01) of parameter No. 2401. Data can also be cleared by pressing the <RESET> key on the MDI panel.

(2) If soft key [CLEAR] is pressed during execution, an

"EXECUTION/MODE SWITCHING IN PROGRESS" warning is generated.

- Halting execution

If one of the following occurs during execution, execution is halted, and data is cleared in the same way as when soft key [CLEAR] is pressed. The remaining amount of travel is canceled.

(1) When a feed hold is applied (2) When the mode is changed to other than the jog feed mode (3) When an alarm is generated

(4) When a reset or emergency stop is applied The M, S, T and B functions remain effective even upon the occurrence of the above events, with the exception of (4).

- Modal information

Model G codes and addresses used in automatic operation are not affected by the execution of commands specified using the manual numeric command function.

- Jog feed

When the tool is moved along an axis using a feed axis and direction selection switch on the manual numeric command screen, the remaining amount of travel is always shown as "0".

Limitation

- Constant surface speed control

S codes cannot be specified in the constant surface speed control mode.

- M, S, T, B functions

Manual numeric commands can be executed while automatic operation is halted. In the following cases, however, a "START IMPOSSIBLE" warning is output, and command execution is disabled. (1) When an M, S, T or B function is already being executed, a

(2) When an M, S, T or B function is already being executed, and that

manual numeric command containing an M, S, T or B function

cannot be executed.

function alone is specified or a block specifying that function also

contains another function (such as a move command or dwell

function) which has already been executed, a manual numeric

command cannot be executed.

- 77 -

3.MANUAL OPERATION OPERATION B-63784EN-1/01

- Jog feed

When a manual numeric command is specified while the tool is being moved along an axis by using a feed axis and direction selection switch, the axial movement is interrupted, and the manual numeric command is executed. For this reason, the tool cannot be moved along an axis by using a feed axis and direction selection switch during execution of a manual numeric command.

- Mirror image

Mirror image cannot be applied in the direction of the specified axis movement.

- Indexing of the index table and chopping

Commands cannot be specified for an axis along which operation is being performed during indexing or chopping. If such an axis is specified for execution, a "START IMPOSSIBLE" warning is generated.

- 78 -

fanuc 15i-MB Operators Manual

Specifications and Main Features

Frequently Asked Questions

User Manual

SAFETY PRECAUTIONS

DEFINITION OF WARNING, CAUTION, AND NOTE

GENERAL WARNINGS AND CAUTIONS

WARNINGS AND CAUTIONS RELATED TO PROGRAMMING

WARNINGS AND CAUTIONS RELATED TO HANDLING

WARNINGS RELATED TO DAILY MAINTENANCE

TABLE OF CONTENTS

I GENERAL

1 GENERAL

1.2 NOTES ON READING THIS MANUAL

II OPERATION

1 GENERAL

1.1 MANUAL OPERATION

1.3 AUTOMATIC OPERATION

1.4 TESTING A PROGRAM

1.4.1 Check by Running the Machine

How to View the Position Display Change without Running the Machine

1.5 EDITING A PART PROGRAM

1.6 DISPLAYING AND SETTING DATA

1.7 DISPLAY

1.7.1 Program Display

1.7.2 Current Position Display

1.7.3 Operator Message Display

1.7.4 Alarm Display

1.7.5 Parts Count Display, Run Time Display

1.7.6 Graphic Display

1.8 DATA INPUT/OUTPUT

2 OPERATIONAL DEVICES

2.1 SETTING AND DISPLAY UNITS

2.1.1 9.5"/10.4" LCD Unit

2.1.2 MDI Unit

2.1.3 MDI Unit (Full-keyboard)

2.1.4 MDI Unit (Main Panel A/B) for Machine Operator's Panel

2.2 EXPLANATION OF THE KEYBOARD

2.3 OPERATION SCREEN DISPLAY

OPERATIONS SUPPORTED BY EACH OPERATION SCREEN

2.5 FUNCTION KEYS AND SOFT KEYS

2.5.1 General Screen Operations

2.5.2 Function Keys

2.5.3 Soft Keys

2.5.4 Function Selection Keys

2.5.5 Chapter selection keys

2.5.5.1 Position

2.5.5.2 Program

2.5.5.3 Offset/Setting

2.5.5.4 System

2.5.5.5 Messages

2.5.5.6 Drawing

2.5.6 Key Input and Input Buffer

2.5.6.1 Inserting characters

2.5.6.2 Deleting characters

2.5.7 Warning Messages

2.6 LANGUAGE SELECTION

2.7 EXTERNAL I/O DEVICES

2.7.1 FANUC Handy File

2.7.2 FANUC Floppy Cassette

2.7.3 FANUC FA Card

2.8 POWER ON/OFF

2.8.1 Turning on the Power

2.8.2 Power Disconnection

3 MANUAL OPERATION

3.1 MANUAL REFERENCE POSITION RETURN

3.2 JOG FEED

3.3 INCREMENTAL FEED

3.4 MANUAL HANDLE FEED

3.5 MANUAL FEED IN A SPECIFIED DIRECTION

3.6 MANUAL NUMERIC COMMAND