Hypertherm Automation Family Instruction Manual (IM)

Download

Automation

Hypertherm Automation 5 Technology Drive, Suite 300 W. Lebanon, NH 03784 USA Phone: 603-298-7970 Fax: 603-298-7977

PHOENIX® SOFTWARE FOR

YPERTHERM SHAPE CUTTING CONTROL

PROGRAMMER’S REFERENCE

Version 8.5 for Touch Screen CNCs

January 2009

ISCLAIMER The information in this document is subject to change without notice and should not be

construed as a commitment by Hypertherm Automation. Hypertherm Automation assumes no responsibility for any errors that appear.

RADEMARKS Hypertherm Automation is a wholly owned subsidiary of Hypertherm, Inc.

Command, HT 4400, HD3070 HyDefinition Plasma and HD4070 HyDefinition Plasma

are registered trademarks of Hypertherm, Inc. FASTLaser is a trademark of Hypertherm, Inc. EDGE, HyperCAD, HyperNet, HyperNest, Phoenix, and ShapeWizard are registered

trademarks of Hypertherm Automation.

Align, APC, CutPro, Gemini, HPR130, HPR260 HyPerformance Plasma, Mariner,

Nester, Remote Help, Sensor, and Voyager are trademarks of Hypertherm Automation. HASP is a registered trademark of Aladdin Knowledge Systems Ltd. Indramat is a trademark of Bosch Rexroth. Pacific Scientific is a trademark of Danaher Motion.

Pentium and Celeron are registered trademarks of Intel Corporation. Virus Scan is a registered trademark of McAfee Associates, Inc.

Microsoft, the Microsoft logo, and Windows are registered trademarks of Microsoft

Corporation. NJWIN is a registered trademark of NJStar Software Corporation. SERCOS Interface is a trademark of SERCOS North America.

Norton AntiVirus and Norton Ghost are trademarks of Symantec Corporation.

Other trademarks are the property of their respective holders.

Printed in USA

Contents

Editing Part Programs ............................................................................................... 1-1

Shape Library ......................................................................................................... 1-1

Text Editor .............................................................................................................. 1-2

Shape Wizard ......................................................................................................... 1-3

Teach Trace ............................................................................................................ 1-5

Remnant Trace Mode ........................................................................................ 1-5

Teach Trace Mode ............................................................................................ 1-6

HyperCAD ............................................................................................................. 1-10

Automatic Nesting ................................................................................................. 1-11

Nesting Screen Layout .................................................................................... 1-11

Automatic Nesting Setup ................................................................................. 1-12

Using Automatic Nesting ................................................................................. 1-13

Adding a Part ................................................................................................... 1-13

Deleting a Part ................................................................................................. 1-18

Nest Summary ................................................................................................. 1-20

ASCII Codes ................................................................................................................ 2-1

Control Codes ......................................................................................................... 2-1

All Codes ................................................................................................................ 2-3

EIA RS-274D Program Support ................................................................................. 3-1

Directly Supported EIA Codes ................................................................................ 3-1

Mapped EIA Codes ................................................................................................. 3-8

Unsupported EIA Codes ....................................................................................... 3-11

EIA Comments ...................................................................................................... 3-13

EIA Example: ................................................................................................... 3-13

ESSI Code Support .................................................................................................... 4-1

Mapped ESSI Codes .............................................................................................. 4-1

Unsupported ESSI Codes ....................................................................................... 4-5

ESSI Comments ..................................................................................................... 4-6

Advanced Feature Codes .......................................................................................... 5-1

Kerf Table Codes .................................................................................................... 5-1

Tilt / Rotator Part Codes ......................................................................................... 5-1

Automatic Torch Spacing Program Codes .............................................................. 5-2

Station Select Codes .............................................................................................. 5-2

Process Select Codes ............................................................................................. 5-3

Station Configuration Variables .............................................................................. 5-3

Lifter ........................................................................................................................ 5-3

Power Supplies ....................................................................................................... 5-3

Marker ..................................................................................................................... 5-4

Laser ....................................................................................................................... 5-4

Automatic Torch Spacing ........................................................................................ 5-4

Automatic Torch Spacing Program Codes ........................................................ 5-6

Automatic Torch Spacing I/O ............................................................................. 5-6

Automatic Plate Alignment Codes ..................................................................... 5-6

Example Part Program ............................................................................................ 5-7

Subparts ...................................................................................................................... 6-1

Marker Font Generator ............................................................................................... 7-1

Internal Fonts .......................................................................................................... 7-3

External Fonts ......................................................................................................... 7-3

Custom Fonts ......................................................................................................... 7-3

Sensor THC Programming Support .......................................................................... 8-1

THC Index Code ..................................................................................................... 8-2

Plasma Supply Programming Support ..................................................................... 9-1

HPR and HD4070 Support ...................................................................................... 9-1

HD3070 Support ..................................................................................................... 9-5

FineLine Support ..................................................................................................... 9-6

Serial Messaging ...................................................................................................... 10-1

Overview ............................................................................................................... 10-1

Options ................................................................................................................. 10-1

Programming Code ............................................................................................... 10-3

Message Command Type ..................................................................................... 10-4

Optional Format Value .......................................................................................... 10-4

Specialty Characters Supported ...................................................................... 10-4

Optional Format Character Assignments ......................................................... 10-5

Optional Delay Time/Time Out Value .................................................................... 10-6

Optional Port ......................................................................................................... 10-6

Message Text Content .................................................................................... 10-6

Non-Printing Characters ....................................................................................... 10-6

Character Options ........................................................................................... 10-7

Exceptions / Additions ..................................................................................... 10-7

Non-Printing Character Table ............................................................................... 10-7

ASCII Codes Less Than Hexadecimal 20 ....................................................... 10-7

8 bit Character Codes Greater Than Hexadecimal 80 ..................................... 10-8

Importing Prepared DXF Files ................................................................................. 11-1

Drawing Format .................................................................................................... 11-1

Text Commands .................................................................................................... 11-1

Directional Commands .......................................................................................... 11-1

Editing Part Programs

Shape Library

The CNC contains a built-in Shape Library with more than 68 commonly used shapes. These shapes are parametric. Parametric shapes are shapes whose size or geometry you can edit. The shapes in the library are color-coded from easy (green) to difficult (black).

To select a simple shape:

1. On the Main screen, press Shape Manager

2. Double click a shape. or Press a shape and press OK.

3. If the selection is incorrect, press Cancel and select the shape again.

Keypad operation:

1. Use the arrow keys to navigate to a shape.

2. Press Enter.

The shape is displayed with the default parameters or the parameters from the last time this shape was edited. For more information on the available shapes, see Library Shapes in the Operator’s Manual.

1-1

Programmer’s Reference

Text Editor

The text editor screen allows you to write or edit a part program in either ESSI or EIA format. The current part that is in memory is displayed when this screen opens.

Changes can be made by pressing on the desired line of code. An alphanumeric keyboard displays to allow you to enter changes.

To edit code:

1. Select or press a line of code. On the CNC, the alphanumeric keypad displays.

2. Enter changes to existing lines of code or add new lines.

3. Press OK to save your changes. If you want to save the changes to the hard drive, select Files > Save to Disk.

4. Press Cancel to return to the previous screen without saving your changes.

Show Original Text

Delete Part Deletes the current part from the Text Editor so that a new part can be

Allows you to view and edit the part program in its original format.

constructed.

1-2

Editing Part Programs

Shape Wizard

ShapeWizard® is a proprietary graphical part editor that provides a user-friendly,

graphical interface for editing part programs. You can view not only the segment that is being edited, but other changes that are

made, as well. There are a number of features on the Shape Wizard screen to facilitate editing part

programs:

• The shape you selected is displayed in the Preview Window and the corresponding code is displayed in the EIA Text window.

• As you edit lines of code, the changes are visible in the Preview Window.

• You can add or modify EIA RS-274D codes in a part program in the EIA Text

window.

• If you don’t know EIA RS-274D codes, you can edit or create segments by making entries and selections in the Segment Data fields below the EIA Text window.

• Zoom keys decrease or increase the size of the part in the Preview Window.

To edit a part program in the EIA Text window:

1. Press or click on a line of code to highlight it.

1-3

Programmer’s Reference

2. Press or click Manual Line Edit. The alphanumeric keypad is displayed for line edits.

3. Type over a line to replace the text. The ASCII text that you enter must be a valid EIA RS-274D code or an error message will display.

4. To view data about the segment of the part that you have highlighted, select the View Segment Data Below checkbox.

5. You can use the Segment Type field and related fields to change the highlighted segment type and add it to the program.

6. While a line is highlighted in blue, you can use soft keys to replace a segment or add a new one:

Replace Segment

Insert Before Segment

Insert After Segment

Remove Segment

7. As you edit a line of code, the picture of the part in the Preview window is updated. The corresponding segment is highlighted in red if it is a cut segment or in blue if it is a traverse.

Replaces the segment highlighted in gray in the Text Editor window with the segment selected from the Segment Type window.

Inserts the segment selected from the Segment Type window to be inserted before the segment highlighted in gray in the Text Editor window.

Inserts the segment selected from the Segment Type window after the segment highlighted in gray in the Text Editor window.

Deletes the segment that is highlighted in gray or blue in the EIA Text window from the part program.

1-4

Editing Part Programs

Teach Trace

The Teach Trace function of the CNC allows parts and remnants to be traced rather than programmed. The position information from the traced part remains as a part program that can be saved to disk.

The Teach Trace algorithms in the CNC can recognize both arcs and lines. This reduces the overall memory required to store these parts and improves the smoothness of the cut.

The traced part in memory is in EIA format and can be cut, saved or edited using any of the part options.

Teach Trace has two modes, Remnant Trace and Teach Trace. The screen opens in Remnant Trace mode. Press the Select Teach Trace Mode soft key to use Teach Trace.

Remnant Trace Mode

In Remnant Trace mode, you can trace the outline of a plate remnant and save it as a file so that it can be used later and nests of parts can be cut from the remnant.

To trace a remnant:

1. On the TeachTrace screen, press the Select Remnant Mode soft key.

1-5

Programmer’s Reference

2. Jog to the point on the Remnant window where you want the trace to begin. Use the joystick or jog keys to move the torch over the plate.

3. Press or click First Point.

4. Jog to the next point and press or click Next Point. Repeat this step until you have traced all but the final point.

5. When the pointer is over the last point you need to trace, press or click Last Point. Trace Remnant draws a line between this point and the first point to close the remnant.

6. Press or click OK to let TeachTrace create the remnant. TeachTrace connects the last point to the first point automatically and returns to the Preview Window.

7. Press or click Files then Save to Disk.

8. Select a folder for the new remnant file from the Save to dropdown list. It is helpful to create a folder named Remnant to hold your remnant files.

9. Enter a file name in the File Name field.

10. Press or click OK.

Teach Trace Mode

1-6

Editing Part Programs

The Teach Trace function must be used with an optional stand-alone optical tracing system.

1-7

Programmer’s Reference

To trace a part:

1. Press Select Auto Mode to trace the part automatically.

2. Press Select Manual Mode to trace the part manually. This also enables the Change Move Speed button so you can change the speed at which the sensor moves.

3. Select traverse or pierce. You can switch between traverse and pierce during the tracing procedure.

4. Position the optical sensor near the part drawing.

5. Press Start. Use the sensor positioning controls to direct the sensor towards the part.

6. After the sensor has located the part, the tracing system will follow the part outline until completion.

7. If you are using manual mode, you can press the Change Move Speed button repeatedly to select a speed for the optical sensor.

8. When the tracing system is finished tracing, press OK. You can cut, save or edit the part.

1-8

Editing Part Programs

Start Corner Allows you to select where the part you trace will begin for proper

viewing on the screen.

Tracing Pitch Determines how precisely to learn a part. The Tracing Pitch can be

adjusted to favor the resolution or size of the taught part. This value does not affect the actual position resolution of the part.

A good starting point for most tracing systems is 0.01”.

Arc Radial Error

Auto Closure Detect

Closure Over/Under Lap

Kerf Direction Selects the kerf for cut segments. Traverse/Pierce Switches between the traverse and cut segments of the part as it is

Specifies the arc error tolerance to be used when checking the current segment for dimensional accuracy. All ESSI or EIA programs are comprised of lines, arcs, and circles. Arc Radial Error is used to ensure that the starting and ending radial vectors are within tolerance to describe a valid geometry.

Allows the CNC to detect that it has returned to the starting point. With this feature on, the CNC stops the motion of the tracer when the part is complete and programs a lead-out.

By specifying a positive value for this parameter, the CNC does not stop the tracer until it has gone past the start point by the value of this parameter.

Specify a negative value to stop the tracer as soon as the tracing head position is within this parameter’s distance of the starting point. This is only available if the Auto Closure Detect is On.

taught.

Select Auto/Manual Mode

Change Move Speed

Select Remnant Mode

Refer to the instructions provided with your Optical tracing system for additional details.

Use this button to change trace modes. If you select manual mode, you can also use the Change Move

Speed button to change the trace speed. Press this button to change the trace speed in manual mode.

Press this button to use remnant mode to create remnants.

1-9

Programmer’s Reference

HyperCAD

HyperCAD is an easy to use 2D drawing application specifically designed for shape cutting. The software’s powerful CAD utilities let users import DXF and CNC files or draw from scratch. Files can be converted to graphical parts for editing and saving or go directly to cutting.

HyperCAD is a simple CAD/CAM application that lets you move easily from drawing to cutting. Its features include:

• English or Metric Units

• Part/sheet viewing capabilities

• Scaling, mirroring or rotating of parts

• Repeating and copying of shapes

• Moving/modifying of lead-ins and lead-outs

• Add-on of chamfers, fillets and notches

• On-screen, full-part cutting simulation

• Built in Help functions

This feature is offered as a limited use trial version. Contact your CNC vendor for information on enabling unlimited use of this feature. This package may be used on the CNC equipped with mouse and PC keyboard or offline on a PC.

1-10

Editing Part Programs

Automatic Nesting

Note: This software feature on the CNC is protected by a hardware key. If the

hardware key has been removed from the CNC, the following message appears when the Nest Parts soft key is pressed.

Nesting Screen Layout

The preview window is located in the upper left corner of the Nester screen and is used to preview manual nests. During an automatic nest, this area remains blank.

The plate size that is used during automatic nesting is based on plate information that has been selected at the main setup screen.

The Files window in the upper right corner displays the list of part programs and quantities of parts that have been selected for nesting. In the lower right, there are fields to specify the location and name of the nest file.

1-11

Programmer’s Reference

Automatic Nesting Setup

To set up automatic nesting:

1. From the Main screen, select Shape Manager > Nesting > Setup.

2. Use the following setup parameters to configure the automatic nesting process.

Note: If the Setup soft key is not available (grayed out), the feature has not been enabled on your CNC. Contact your CNC vendor for details on how to enable the Automatic Nesting feature.

Nesting Switching Automatic to enable automatic nesting. Part Spacing Sets the spacing between parts during automatic nesting process. Plate Edge

Spacing Program Origin Select the nest start location from the dropdown list. Cut Direction From the dropdown list, select the direction in which the parts will be

Nest Direction Select the direction in which nests are arranged during the automatic

Sets spacing around the edge of the plate.

cut in the automatic nest.

nesting process.

1-12

Editing Part Programs

Return to Nest Start

Use Remnant If remnants are created and saved for future use, select On to use

Generate and Cut Offcut

M65 Auto Reload

When enabled, the Return to Nest Start feature inserts a traverse segment from the end of the nest back to the start point.

one of these remnants for automatic nesting. Select On to generate offcuts for standard, rectangular nests.If this

feature is enabled, offcuts are created when 30% or more of the sheet remains after nesting. The offcut is cut after a pause at the end of the nest on the last nested rectangular sheet.

Select On to allow new sheets to be reloaded automatically. When this feature is selected, there is a pause at the end of each

sheet until the operator presses Start to Resume. Then, a new sheet automatically loads and runs.

Auto reload works with standard, rectangular nests only.

Using Automatic Nesting

To begin using Nesting:

1. On the Shape Manager screen, select Nester > Setups.

2. On the Setup screen, select Automatic for the Nesting option.

3. Configure the setup parameters.

4. Press OK to return to the Nesting screen and begin adding parts to the nest.

Adding a Part

To add a part to a nest part list:

1. On the Nesting screen, press the Add Part soft key.

1-13

Programmer’s Reference

2. On the Add Part screen, use the soft keys at the bottom to select the source of a part file; Shape Library, disk, or host.

1-14

Editing Part Programs

3. Select the part you want to add:

• In the Shape Library, double-click or press a shape.

• On the Load from Disk screen, select the source of the file from the Load from

dropdown list and then select the file from the Files list.

• On the Download from Host screen, select the source of the file from the

Download dropdown list and then select the file from the Files list.

1-15

Programmer’s Reference

4. To narrow down the list of files in the Files list, click or press the Show Certain Files soft key.

5. On the keyboard that displays, enter wildcard characters and a portion of the file name you are looking for. For example, if you enter *Rect, you will see the following list of files:

6. To return to the complete list of files, click or press Show All Files.

7. Select the Preview checkbox to view the part you selected in the Preview window.

8. Click or press Cancel to return to the Add a Part screen without adding the part.

9. Click or press OK to add the part to the nest.

10. On the Part Setup screen, enter values in the setup parameters, as necessary for the part you selected.

1-16

Editing Part Programs

11. Click or press OK.

12. In the Part Configuration popup, enter the number of parts to include in the nest and indicate whether the part will be mirrored in the nest, for greater efficiency, or used as a wildcard part. Wildcard parts “fill in” a sheet on which the nest occupies at least 75% of the sheet.

13. As you add new parts to the nest, file names and quantity are listed in the Files window on the Nesting screen.

14. Save the nest of parts:

a. Select the file location from the Save to dropdown list. b. Enter name for the nest file in the File name field. c. Click or press OK to begin the automatic nesting process.

A window displays the progress of the nesting process.

1-17

Programmer’s Reference

Note: The nest process progresses quickly and all shapes may not be visible on the screen. Other drawing anomalies may be noted during the nesting process.

If more parts are selected than can fit on one plate, multiple plates or sheets (nested program) files are generated and saved in the selected folder with the selected file name, but a numeric suffix is added. For example, if you saved the part file as Nest, the nesting process may generate multiple part files named NEST1.txt, NEST2.txt, NEST3.txt, and so on. The numbers in the file names indicate the number of individual sheets that are needed for the nest selection, based on the sheet size parameter.

Deleting a Part

To delete a part from the part files list:

1. Select the part name in the files list.

2. Press the Remove Part soft key before you begin the nesting.

1-18

Editing Part Programs

When you have finished nesting your parts, you can view the entire nest in the Preview Window of the Main screen:

Note: Parts with open loops or other invalid geometries may not be able to be automatically nested. It may be possible to manually nest parts which have been rejected by the Automatic Nesting function.

1-19

Programmer’s Reference

Nest Summary

After a nest is completed, the software provides a summary of the Automatic Nesting process.

Statistical analysis of the process is provided for the number of sheets, time to execute nest, total nest utilization and total number of shapes nested.

Note: Sheets that are generated with the same part configuration are listed as “Sheet No. # (total #)”.

1-20

Editing Part Programs

To view the summary:

1. Scroll down to view an analysis of the parts, the individual sheets produced, and a listing of the net utilization for the specific sheet.

2. Press OK to accept the nest and have the first sheet become the current part.

1-21

Programmer’s Reference

3. Press Cancel to reject the nest and return to the main nesting screen to add or remove parts from the nest.

1-22

ASCII Codes

This appendix provides the 128 ASCII codes (American Standard Code for Information Interchange) as defined by ANSI (American National Standards Institute) Standard X3.4-1977.

Control Codes

Hex Dec Character Name Description

00 0 ^ @ NUL Null 01 1 ^A SOH Start of Header 02 2 ^B STX Start of Text 03 3 ^C ETX End of Text 04 4 ^D EOT End of Transmission 05 5 ^E ENQ Enquiry 06 6 ^F ACK Acknowledge 07 7 ^G BEL Bell 08 8 ^H BS Backspace 09 9 ^I HT Horizontal Tab 0A 10 ^J LF Line Feed 0B 11 ^K VT Vertical Tab 0C 12 ^L FF Form Feed 0D 13 ^M CR Carriage Return 0E 14 ^N SO Shift Out 0F 15 ^O SI Shift In 10 16 ^P DLE Data Link Escape 11 17 ^Q DCI Device Control 1 12 18 ^R DC2 Device Control 2 13 19 ^S DC3 Device Control 3 14 20 ^T DC4 Device Control 4 15 21 ^U NAK Negative Acknowledge 16 22 ^V SYN Synchronous Idle 17 23 ^W ETB End Transmission Block 18 24 ^X CAN Cancel 19 25 ^Y EM End of Medium

2-1

Programmer’s Reference

1A 26 ^Z Sub Substitute 1B 27 ^[ ESC Escape 1C 28 ^\ FS File Separator 1D 29 ^] GS Group Separator 1E 30 ^^ RS Record Separator 1F 31 ^_ US Unit Separator 20 32 SP Space

2-2

ASCII Codes

All Codes

Hex Dec Symbol Hex Dec Symbol Hex Dec Symbol

00 0 ^ @ 2B 43 + 56 86 V 01 1 ^A 2C 44 , 57 87 W 02 2 ^B 2D 45 - 58 88 X 03 3 ^C 2E 46 . 59 89 Y 04 4 ^D 2F 47 / 5A 90 Z 05 5 ^E 30 48 0 5B 91 [ 06 6 ^F 31 49 1 5C 92 \ 07 7 ^G 32 50 2 5D 93 ] 08 8 ^H 33 51 3 5E 94 ^ 09 9 ^I 34 52 4 5F 95 _ 0A 10 ^J 35 53 5 60 96 ` 0B 11 ^K 36 54 6 61 97 a 0C 12 ^L 37 55 7 62 98 b 0D 13 ^M 38 56 8 63 99 c 0E 14 ^N 39 57 9 64 100 d 0F 15 ^O 3A 58 : 65 101 e 10 16 ^P 3B 59 ; 66 102 f 11 17 ^Q 3C 60 < 67 103 g 12 18 ^R 3D 61 = 68 104 h 13 19 ^S 3E 62 > 69 105 i 14 20 ^T 3F 63 ? 6A 106 j 15 21 ^U 40 64 @ 6B 107 k 16 22 ^V 41 65 A 6C 108 l 17 23 ^W 42 66 B 6D 109 m 18 24 ^X 43 67 C 6E 110 n 19 25 ^Y 44 68 D 6D 111 o 1A 26 ^Z 45 69 E 70 112 p 1B 27 ^[ 46 70 F 71 113 q 1C 28 ^\ 47 71 G 72 114 r

2-3

Programmer’s Reference

1D 29 ^] 48 72 H 73 115 s 1E 30 ^^ 49 73 I 74 116 t 1F 31 ^_ 4A 74 J 75 117 u 20 32 4B 75 K 76 118 v 21 33 ! 4C 76 L 77 119 w 22 34 “ 4D 77 M 78 120 x 23 35 # 4E 78 N 79 121 y 24 36 $ 4F 79 O 7A 122 z 25 37 % 50 80 P 7B 123 { 26 38 & 51 81 Q 7C 124 | 27 39 ‘ 52 82 R 7D 125 } 28 40 ( 53 83 S 7E 126 ~ 29 41 ) 54 84 T 7F 127

2A 42 ‘ 55 85 U

←

2-4

1BEIA RS-274D Program Support

The control supports EIA RS-274D part programs. An EIA RS-274D program lists the sequence of lines, arcs, speeds, kerf and I/O functions that are used to create a part. While the user is free to program in EIA using the standard text editor, it is recommended that the ShapeWizard® Graphical Programming environment be used instead.

Following is a list of the EIA codes that are directly supported, mapped, or currently unsupported by the control. Mapped EIA codes are automatically converted upon program load into directly supported EIA codes. Unsupported EIA codes are ignored. All other EIA codes generate an error.

10BDirectly Supported EIA Codes

EIA Code Description Fvalue Machine Speed (if Speed Override enabled) Nvalue Line Number (text) Comments Xvalue X Axis Endpoint or other Data Yvalue Y Axis Endpoint or other Data Ivalue I Axis Integrand or Part Option Data Jvalue J Axis Integrand or Part Option Data Ovalue Svalue Output (1-64), State (0-Off or 1-On) Wvalue Svalue Wait for Input (1-64), State (0-Off or 1-On) G00 Rapid Traverse Linear Interpolation G00 Avalue Sets Tilt angle – A is the angle value in degrees G00 XYval Aval Performs Linear Interpolation of Tilt angle along line segment. G01 Avalue

Sets Tilt angle value in degrees with a speed command in RPM

Fvalue G00 Xn Yn Traverse command where n = value to move the desired axes a

distance.

G00 Zx.xx Tx Index Sensor™ THC height “Z” distance for torch “T”. Manual mode

only.

3-1

Programmer’s Reference

G00 Cxx Move to rotate “C” position G01 Cxx Fxx Move to rotate “C” position with Speed “F” command in RPM G00 C180- Rotate Axis offset 180 degrees will continue to rotate in the proper

direction

G00 C-180- Rotate Axis offset -180 degrees will continue to rotate in the proper

direction G01 C180- Fxx Rotate Axis offset 180 degrees with speed G01 C-180-

Fxx G01 Linear Interpolation (at Cut Speed) G02 Clockwise Circular Interpolation G03 Counterclockwise Circular Interpolation G04 Preset Dwell (uses Setup Dwell Time) G04 Xvalue Program Dwell in Seconds G08 Xvalue Repeat Subroutine X Times G20 Select English Units (inches) G21 Select Metric Units (mm) G40 Disable Kerf Compensation G41 Enable Left Kerf Compensation

Rotate Axis offset -180 degrees with speed

G42 Enable Right Kerf Compensation G43 Xvalue Kerf Value G41 D1-200 Enables Left Kerf using a Kerf Table variable G42 D1-200 Enables Right Kerf using a Kerf Table variable G43 D1-200 Sets the current Kerf value via the Kerf Table using prior set Left /

Right Kerf G59 D1-

200Xvalue

Sets Kerf table variable from 1-200

3-2

EIA RS_274D Code Support

G59 Vvalue Fvalue

G66 Dval Bval Cval

G82 Oxy-Fuel Cut Mode G83 Oxy-Fuel Cut Mode Contour Bevel Head G84 Plasma Cut Mode G85 Plasma Cut Mode Contour Bevel Head G90 Absolute Programming Mode G91 Incremental Programming Mode

Sets the Plasma Supply current through Outputs or Serial Link for

Vprocess (504,514,524,534) at Fcurrent value

V504 – Current Setting Plasma 1

V514 – Current Setting Plasma 2

V524 – Current Setting Marker 1

V534 – Current Setting Marker 2

Auto Align 3 Point Method with Long Offset Distance, Fast Speed,

Slow Speed values respectively

G92 Set Axis Presets G97 Program Repeat Pointer G97 Tvalue Program Repeat Pointer. Executes the repeat T times G98 Repeat at G97, or start of program if no G97 G99 Part Options M00 Program Stop M01 Optional Program Stop (uses Setup Parameter) M02 End of Program M07 Cutting Device On M08 Txx.xx Cutting Device Off (Temporary Optional Time Delay from –1 to 99.99

seconds) M09 Enable Marker 1 M10 Disable Marker 1

3-3

Programmer’s Reference

M11 Marker Offset 1 On M12 Marker Offset 1 Off M13 Enable Marker 2 M14 Disable Marker 2 M15 Cut On M16 Cut Off M17 Oxy Gas On M18 Oxy Gas Off M19 Cancel All Stations M26 Station Select On M27 Station Select Off M28 CBH / Rotator(s) Disable M29 CBH / Rotator(s) Enable M30 End of Program (same as M02) M31 Reset Functions (Cut Off, Marker Off, Kerf Off) M32 Unclamp / Unlock All Stations M32 Tvalue Unclamp / Unlock ‘T” Station, where T = 1 through 19 M33 Unclamp / Lock All Stations M34 Clamp / Unlock All Stations M34 Tvalue Clamp / Unlock ‘T” Station, where T = 1 through 19 M35 Clamp / Unlock All Stations Mirror M35 Tvalue Clamp / Unlock Mirror “T” Station, where T = 1 through 19 M36 Tvalue Process Select “T” where T value selects the process

1 – Plasma 1

2 – Plasma 2

3-4

3 – Marker 1

4 – Marker 2

5 – Laser

EIA RS_274D Code Support

M37 Tvalue (1-20)

M38 Tvalue (1-20)

M40 Start of Subroutine M40 Xvalue Start of Subroutine. Executes the repeat X times M41 End of Subroutine M48 Speed Override Enable M49 Speed Override Disable M50 Height Sensor Disable M51 Txx.xx Height Sensor Enable (Temporary Optional Time Delay in seconds

M52 Height Sensor Disable and Raise Torch

Select Station “T” where T = 1 through 20

Deselect Station “T” where T = 1 through 20

before Enable)

M53 Height Sensor Enable and Lower Torch M63 User Defined 1 On M64 User Defined 1 Off M54 User Defined 2 On M55 User Defined 2 Off M56 User Defined 3 On M57 User Defined 3 Off M58 User Defined 4 On M59 User Defined 4 Off M65 End of Program (same as M02) or Auto Reload M72 Marker Offset 2 Off

3-5

Programmer’s Reference

M73 Marker Offset 2 On M75 A Axis/Tilt Go to Home Command - Rapid Index M76 C Axis/Rotate Go to Home Command - Rapid Index M77 Go to Home position Y Axis M78 Go to Home position X Axis M79 Tvalue

(1-4) M90 Aligns CBH / Rotator to Tangent angle of next cut segment M90- Align rotator negative, when not using shortest path motion M274 Marker Offset 3 Off M275 Marker Offset 3 On M276 Marker Offset 4 Off M277 Marker Offset 4 On M278 Marker Offset 5 Off M279 Marker Offset 5 On M280 Marker Offset 6 Off M281 Marker Offset 6 On

Go To Home Position (1-4)

M282 Marker Offset 7 Off M283 Marker Offset 7 On M284 Marker Offset 8 Off M285 Marker Offset 8 On M286 Marker Offset 9 Off M287 Marker Offset 9 On M288 Marker Offset 10 Off M289 Marker Offset 10 On

3-6

EIA RS_274D Code Support

M290 Marker Offset 11 Off M291 Marker Offset 11 On M292 Marker Offset 12 On M293 Marker Offset 12 On M301 Assigns the current X/Y position to Home Position 1 M302 Assigns the current X/Y position to Home Position 2 M303 Assigns the current X/Y position to Home Position 3 M304 Assigns the current X/Y position to Home Position 4 M305 Assigns the current X/Y position to Home Position 5 M306 Assigns the current X/Y position to Home Position 6 M307 Assigns the current X/Y position to Home Position 7 M308 Assigns the current X/Y position to Home Position 8 M309 Assigns the current X/Y position to Home Position 9 M310 Assigns the current X/Y position to Home Position 10 M311 Assigns the current X/Y position to Home Position 11 M312 Assigns the current X/Y position to Home Position 12

3-7

Programmer’s Reference

Mapped EIA Codes

EIA CODE DESCRIPTION MAPPED TO

G04 Fvalue Program Dwell G04 Xvalue G05 Set Axis Presets G92 G21 Linear Interpolation G01 (at cut speed) G22 CW Circular Interpolation G02 G23 CCW Circular Interpolation G03 G41 Kvalue Left Kerf with Value G41 with Kerf Value G42 Kvalue Right Kerf with Value G42 with Kerf Value G97 TValue Subroutine Loop G08 Xvalue and M40 G45 Lead In to Kerfed Part G01, G02, or G03 G70 Select English Units G20 G71 Select Metric Units G21 G98 End of Subroutine Loop M41 M03 Cutting Device On/Off M07 (Oxy Fuel) or M08 as

appropriate M04 Cutting Device On M07 M05 Cutting Device Off M08 (Oxy Fuel) M06 Cutting Device Off M08 M06 Enable Marker 2 M13 M07 Disable Marker 1 or 2 M10 or M14 as appropriate M08 Enable Marker 1 M09 M09 Disable Marker 1 or 2 M10 or M14 as appropriate M10 Enable Marker 2 M13 M14 Height Sensor Disable M50

3-8

EIA RS_274D Code Support

M15 Height Sensor Enable M51 M20 Cutting Device On/Off M07 or M08 as appropriate

(Plasma) M21 Cutting Device On/Off M07 or M08 as appropriate

(Plasma) M20 Output 9 On O9 S1 M21 Output 9 Off O9 S0 M22 Output 12 On O12 S1 M23 Output 12 Off O12 S0 M24 Wait for Input 7 On W7 S1 M25 Wait for Input 8 On W8 S1 M25 CBH Enable M29 M26 Wait for Input 7 Off W7 S0 M26 CBH Disable M28 M27 Wait for Input 8 Off W8 S0 M67, M02 Kerf Left G41 M68, M03 Kerf Right G42 M69, M04 Kerf Off G40 M65, M70 Cutting Device On M07 M66, M71, M73 Cutting Device Off M08 M70 Marker Offset 1 Off M12 M71 Marker Offset 1 On M11 M70T01 Marker Offset 1 Off M12 M71T01 Marker Offset 1 On M11 M70T02 Marker Offset 2 Off M72 M71T02 Marker Offset 2 On M73

3-9

Programmer’s Reference

M70T03 Marker Offset 3 Off M274 M71T03 Marker Offset 3 On M275 M70T04 Marker Offset 4 Off M276 M71T04 Marker Offset 4 On M277 M70T05 Marker Offset 5 Off M278 M71T05 Marker Offset 5 On M279 M70T06 Marker Offset 6 Off M280 M71T06 Marker Offset 6 On M281 M70T07 Marker Offset 7 Off M282 M71T07 Marker Offset 7 On M283 M70T08 Marker Offset 8 Off M284 M71T08 Marker Offset 8 On M285 M98 End Comment ) M99 Start Comment ( M221 No Mirror, No Rotate G99 X1 Y0 I0 J0 M222 Mirror Y, No Rotate G99 X1 Y0 I0 J1 M223 Mirror X and Y G99 X1 Y0 I1 J1 M224 Mirror X, No Rotate G99 X1 Y0 I1 J0 M225 Mirror X/Y on -45 Deg G99 X1 Y270 I1 J0 M226 Rotate 90 Deg CCW G99 X1 Y90 I0 J0 M227 Mirror X/Y on +45 Deg G99 X1 Y270 I0 J1 M228 Rotate 90 Deg CW G99 X1 Y270 I0 J0 M245 Output 1 On O1 S1 M246 Output 1 Off O1 S0 M247 Output 2 On O2 S1

3-10

EIA RS_274D Code Support

M248 Output 2 Off O2 S0 M249 Output 3 On O3 S1 M250 Output 3 Off O3 S0 M251 Output 4 On O4 S1 M252 Output 4 Off O4 S0 M253 Wait for Input 1 On W1 S1 M254 Wait for Input 1 Off W1 S0 M255 Wait for Input 2 On W2 S1 M256 Wait for Input 2 Off W2 S0 M257 Wait for Input 3 On W3 S1 M258 Wait for Input 3 Off W3 S0 M259 Wait for Input 4 On W4 S1 M260 Wait for Input 4 Off W4 S0

Unsupported EIA Codes

EIA CODE DESCRIPTION

G30 Mirror Off G46 Table 0 Select G94 Feed per minute G95 Feed per rev G99 Freestanding G99 G103 Qname Stop Current Program/ Load New Program G201 Incremental Line In2 G202 Incremental CW Arc In2 G203 Incremental CCW Arc In2 G211 Incremental Line In3

3-11

Programmer’s Reference

G212 Incremental CW Arc In3 G213 Incremental CCW Arc In3 G221 Absolute Line In2 G222 Absolute CW Arc In2 G223 Absolute CCW Arc In2 G231 Absolute Line In3 G232 Absolute CW Arc In3 G233 Absolute CCW Arc In3 G240 Programmable Kerf G247 Table 1 Select G248 Table 2 Select G249 Table 3 Select G250 Table 4 Select G276 Internal Variable Load G277 External Variable Load G278 X Axis Home G279 Y Axis Home G280 X Home Return G281 Y Home Return M66 PLC Control Code M75 Ignored if not using CBH, Tilt Rotator(s) M76 Ignored if not using CBH, Tilt Rotator(s) M210 X Sign Toggle M211 Y Sign Toggle M212 X and Y Swap and Toggle

3-12

EIA RS_274D Code Support

M231 Aux. State Reset M261 Aux. Torch Master On M262 Aux. Torch Master Off The unsupported EIA codes previously noted are ignored when read. Some of these

codes may be supported in the future. Any EIA codes that are not listed above will result in a translator error upon loading the EIA program. Known EIA codes that will not be accepted include, but are not limited to:

Pvalue Program Number Dvalue Indexed Kerf Operations Vvalue Internal Variable Load

13BEIA Comments

Comments may be placed into the part program to be displayed on screen and viewed by the operator. The comment line must first be preceded by a program stop command (EIA M00 code or ESSI 0 code).

EIA Example:

M00 – Pauses Program (Comment) – Text to be displayed

3-13

Programmer’s Reference

3-14

ESSI Code Support

The CNC supports ESSI part programs as defined by the International Standards Organization in ISO 6582. An ESSI program lists the sequence of lines, arcs, speeds, kerf and I/O functions used to create a part. While the user is free to program in ESSI using a standard text editor, it is recommended that the ShapeWizard® Graphical Programming environment be used instead.

While the user is free to download ESSI programs to the control, it is important to note that all Part Programs will be internally converted to EIA for execution in the control. Following is a list of the ESSI codes that are mapped into the control, or currently unsupported by the control. Mapped ESSI codes are automatically converted upon program load into directly supported EIA codes. Unsupported ESSI codes are ignored. All other ESSI codes will generate an error.

Mapped ESSI Codes

ESSI CODE DESCRIPTION MAPPED TO EIA

% Start of Program Not Used-Automatic +/-value… Line or Arc G00, G01, G02 or G03 as

appropriate 0 End Program or Stop M02 or M00 (if 64 is End Program) 3 Start Comment ( 4 End Comment ) 5 Enable Rapid Traverse Not Used-Automatic 6 Disable Rapid Traverse Not Used-Automatic 7 Cutting Device On M07 8 Cutting Device Off M08 9 Enable Marker 1 M09 10 Disable Marker 1 M10 11 Marker Offset 1 On M11 12 Marker Offset 1 Off M12 11+1 Marker Offset 1 On M11

4-1

Programmer’s Reference

12+1 Marker Offset 1 Off M12 11+2 Marker Offset 2 On M73 12+2 Marker Offset 2 Off M72 11+3 Marker Offset 3 On M275 12+3 Marker Offset 3 Off M274 11+4 Marker Offset 4 On M277 12+4 Marker Offset 4 Off M276 11+5 Marker Offset 5 On M279 12+5 Marker Offset 5 Off M278 11+6 Marker Offset 6 On M281 12+6 Marker Offset 6 Off M280 11+7 Marker Offset 7 On M283 12+7 Marker Offset 7 Off M282 11+8 Marker Offset 8 On M285 12+8 Marker Offset 8 Off M284 13 Enable Marker 2 M13 14 Disable Marker 2 M14 15 Marker Offset 2 On M73 16 Marker Offset 2 Off M72 21 No Mirror, No Rotate G99 X1 Y0 I0 J0 22 Mirror Y, No Rotate G99 X1 Y0 I0 J1 23 Mirror X and Y G99 X1 Y0 I1 J1 24 Mirror X, No Rotate G99 X1 Y0 I1 J0 25 Mirror X/Y on -45 Deg G99 X1 Y270 I1 J0 26 Rotate 90 Deg CCW G99 X1 Y90 I0 J0

4-2

ESSI Code Support

27 Mirror X/Y on +45 Deg G99 X1 Y270 I0 J1 28 Rotate 90 Deg CW G99 X1 Y270 I0 J0 29 Enable Left Kerf Comp G41 30 Enable Right Kerf Comp G42 38 Disable Kerf G40 39+value Machine Speed Fvalue 40+value Programmable Kerf G43 Xvalue 41 Preset Dwell G04 41+value Program Dwell in mSec G04 Xvalue 45 Ht Sensor Enable/Lower M53 46 Ht Sensor Disable/Raise M52 47 Ht Sensor Enable M51 48 Ht Sensor Disable M50 51 CBH Enable M29 52 CBH Disable M28 53 Cutting Device On M07 54 Cutting Device Off M08 63 Reset Functions M31 64 End Program M02 65 End of Program/ Reload M65 67 Ht Sensor Disable M50 68 Ht Sensor Enable M51 70 Select English Units (in) G20 71 Select Metric Units (mm) G21 79+1 Go To Home Position 1 M79 T1

4-3

Programmer’s Reference

79+2 Go To Home Position 2 M79 T2 79+3 Go To Home Position 3 M79 T3 79+4 Go To Home Position 4 M79 T4 81 Incremental Mode G91 82 Absolute Mode G90 83 Set Axis Presets G92 90 End of Program M02 97 Program Repeat Pointer G97 97+value Subroutine Loop M40 Xvalue 98 Repeat at 97, Subroutine loop G97, G98 or M41 as appropriate

or start of program if no 97 99 End of Program M02 245 Output 1 On O1 S1 246 Output 1 Off O1 S0 247 Output 2 On O2 S1 248 Output 2 Off O2 S0 249 Output 3 On O3 S1 250 Output 3 Off O3 S0 251 Output 4 On O4 S1 252 Output 4 Off O4 S0 253 Wait for Input 1 On W1 S1 254 Wait for Input 1 Off W1 S0 255 Wait for Input 2 On W2 S1 256 Wait for Input 2 Off W2 S0 257 Wait for Input 3 On W3 S1

4-4

258 Wait for Input 3 Off W3 S0 259 Wait for Input 4 On W4 S1 260 Wait for Input 4 Off W4 S0 282 Marker Offset 3 On M275 283 Marker Offset 3 Off M274 284 Marker Offset 4 On M277 285 Marker Offset 4 Off M276 286 Marker Offset 5 On M279 287 Marker Offset 5 Off M278 288 Marker Offset 6 On M281

ESSI Code Support

289 Marker Offset 6 Off M280 290 Marker Offset 7 On M283 291 Marker Offset 7 Off M282 292 Marker Offset 8 On M285 293 Marker Offset 8 Off M284

Unsupported ESSI Codes

ESSI CODE DESCRIPTION

103+Name Stop Current Program/ Load New Program 237 X Sign Toggle 238 Y Sign Toggle 239 X and Y Swap and Toggle 266 Table 1 Select 267 Table 2 Select 268 Table 3 Select

4-5

Programmer’s Reference

269 Table 4 Select 276 Internal Variable Load 277 External Variable Load 278 X Axis Home 279 Y Axis Home 280 X Home Return 281 Y Home Return The unsupported ESSI codes above are ignored when read. Some of these codes may

be supported in the future. Any ESSI codes that are not listed above will result in a translator error upon loading the ESSI program.

ESSI Comments

Comments may be placed in to the part program to be displayed on screen and viewed by the operator. The comment line must first be preceded by a program stop command (EIA M00 code or ESSI 0 code).

ESSI Example:

0 – Pauses Program 3 – Start Comment Comment – Text to be displayed 4 – End Comment

4-6

Advanced Feature Codes

Kerf Table Codes

CODE DESCRIPTION

G59 D1200Xvalue

G41 D1-200 Enables Left Kerf using a Kerf Table variable G42 D1-200 Enables Right Kerf using a Kerf Table variable G43 D1-200 Changes current kerf value via Kerf Table using previously set left or right

Sets kerf table variable from 1-200

kerf

Tilt / Rotator Part Codes

CODE DESCRIPTION

G00 Avalue Sets tilt angle as a preparatory command – A is the angle value in

degrees

G00 XYvalue Avalue

G00 Avalue Fvalue

Performs Linear Interpolation of Tilt angle along line segment.

Sets tilt angle – Angle value in degrees with a speed command in

RPM M28 Disables Follower M29 Enables Follower M90 Preparatory Cmd - Aligns Rotator to Tangent angle of next cut

segment M90- Align rotator when not using shortest path motion M75 A axis/Tilt Goto Home Cmd - Rapid Index G00 Cxx Move to rotate “C” position G01 Cxx Fxx Move to rotate “C” position with Speed “F” command G00 C180- Rotate Axis align 180 degrees will continue to rotate in the proper

direction

5-1

Programmer’s Reference

G00 C-180- Rotate Axis align -180 degrees will continue to rotate in the proper

direction G01 C180- Fxx Rotate Axis align 180 degrees with speed G01 C-180-

Fxx

Rotate Axis align -180 degrees with speed

Automatic Torch Spacing Program Codes

CODE DESCRIPTION

M32 Unclamp / Unlock All Stations M33 Unclamp / Lock All Stations M34 Clamp / Unlock All Stations M34Tvalue Clamp / Unlock ‘T” Station, where T = 1 through 19 M35 Clamp / Unlock All Stations Mirror M35Tvalue Clamp / Unlock Mirror “T” Station, where T = 1 through 19 M77 Go to Home position Y Axis M78 Go to Home position X Axis

Station Select Codes

Stations (Lifter / THCs) can be selected and de-selected using the following EIA-274D program codes.

CODE DESCRIPTION

M19 Tvalue Cancel All Station Selections M37 Tvalue Select Station 1-20 (Tvalue) M38 Tvalue De-Select Station 1-20 (Tvalue) Additionally, these Station Select program codes may be overridden using the user

selected THC inputs to the CNC. The feature to override the part program must be enabled at the Cutting Setup screen.

5-2

Advanced Feature Codes

Process Select Codes

Process selections can be made using a EIA-274D program code in the following format.

Example: M36 Tvalue M36 = Misc. M Code Tvalue = Valve Identity

T1 = Plasma Process 1 T2 = Plasma Process 2 T3 = Marker Process 1 T4 = Marker Process 2 T5 = Laser Process

Station Configuration Variables

The following options are available for station configuration:

Lifter

None Sensor THC Command THC

(with Serial Link)

HD4070 Integrated THC 1 or 2 (used only with the HD4070 power supply)

Other (any standalone lifter station)

Power Supplies

None HD4070 Torch 1or 2 Powermax series Max100/ 100D HT4001 FineLine 100 Max200 HT4100 FineLine 200 HT2000 HT4400 Other (any other Plasma

system)

HD3070 HPR130

5-3

Programmer’s Reference

Marker

None ArcWriter FineLine 100 & 200 HD4070 Torch 1or 2 HPR130 Other (any stand alone

Marker)

Laser

Rofin RF 40 & 50 Rofin DC 35 Rofin TR 60 Other

Automatic Torch Spacing

The automatic torch spacing feature uses codes within the part program, and designated outputs, to perform precise positioning of individual torch stations for multitorch cutting processes.

This feature must be enabled in Machine Setups. The Auto Torch Spacing Override feature in Cutting Setups must also be enabled.

In this process, the primary torch station has a fixed mount to the transverse axis and the other secondary torch stations have the ability to clamp to the mechanics of the transverse axis during use or lock to the gantry or beam when not in use.

For the example, in the following illustration, Torch 1 is the primary station and Torch 24 are the secondary stations.

Typical use is as follows:

1. Unclamp and unlock all stations (except the first which is fixed and slides the others)

2. Go to Home Command on Transverse Axis (M77 or M78 depending on orientation)

5-4

Advanced Feature Codes

3. Clamp and Unlock all carriages and G00 index inward on transverse (optional

command - may used to space all stations away from edge / OT switch of machine)

4. Lock and Unclamp all and G00 index to space first station (remember-first station

has no clamping/locking on board)

5. Unlock and Clamp next station and G00 index to space the next station.

6. Repeat Step 5 until as many stations as needed are spaced. Note: Homing also automatically includes the commands necessary to push the

stations to the side and lock or clamp them whenever the transverse is homed, if Auto Torch Spacing is enabled. Unclamp/ Clamp and Unlock / Lock commands execute a one second delay before moving.

5-5

Programmer’s Reference

Automatic Torch Spacing Program Codes

Code Description

distance.

Automatic Torch Spacing I/O

Station Lock 1-19

Station Clamp 1-19

Station Mirror 1-19

Locks the unused torch station to the gantry or beam when not in use.

Clamps the selected torch station to the transverse axis for standard

cutting.

Clamps the selected torch station to the transverse axis for mirrored

cutting.

Automatic Plate Alignment Codes

Three point alignment distance and speeds can be defined with the following EIA format program code:

G66D100B300C30 G66 3-point alignment command Dvalue Distance between two plate edge reference points Bvalue Rapid feed rate for distance (D) motion Cvalue Slow feed rate for the distance to the edge

5-6

Advanced Feature Codes

Example Part Program

The transverse axis is configured as the X axis Three station cut of 20 inch vertical rip.

Code Description

G70 English Units G91 Incremental Mode G99 X1 Y0 I0 J0 Axes Preset zero Scaling M32 Unclamp / Unlock All Stations M78 Home X Axis (move all stations to Home position) M34 Clamp All / Unlock All G00X2Y0 Traverse X axis 2 inches (to move off edge/ switch) M33 Unclamp All / Lock All G00X10Y0 Traverse X axis 10 inches (to set 10 inch space – station 1) M34 T1 Clamp Station 1 / Unlock Station 1 G00X10Y0 Traverse X axis 10 inches (to set 10 inch space– station 2) M34 T2 Clamp Station 2 / Unlock Station 2 G41 Left Kerf M07 Cut On G01 X0 Y20 Line segment (Y axis 20 inches) M08 Cut Off G40 Kerf Off M02 End of Program

5-7

Programmer’s Reference

5-8

Subparts

Subparts allow you to call and execute a separate part file within a part program using a simple line of text.

To configure a subroutine part for use, the user must first create a folder on the CNC hard drive named “SUBPARTS”. To create a folder on the hard drive, select Load From Disk. With the folder location highlighted, press the + key to create a new folder.

Save the part program in the SUBPARTS folder. To execute the part, insert a line of code within the part program with the following

format.

PFILENAME

Start the line of code with the letter P to indicate that a Sub Part is to be executed, followed by the filename for the desired part program.

For example, to execute subpart L-Bracket after completing a simple 5” x 5” square with a programmed traverse, the part program would look something like the following example:

(Rectangle - Piece) G20 G91 G99 X1 Y0 I0 J0 G41 M07 G01 X-5.2 Y0 G01 X0 Y5 G01 X5 Y0 G01 X0 Y-5.2

6-1

Programmer’s Reference

M08 G00 X.75 Y0 PL-BRACKET G40 M02

When it is executed, this program will be represented as the original part plus the additional subpart and will include the programmed traverse.

Note: Subparts can also contain subparts. After being translated by the CNC, the final text of the part will contain the complete text of the original part and subpart.

6-2

Marker Font Generator

The Marker Font Generator feature can be used to label or identify parts with a marking device before cutting. This is accomplished by use of a simple command string within the part program code to call existing text characters (fonts) and execute marking of the selected text.

The program code uses a specific format and is structured to provide information to be used when marking. Information on the font source location, scale factor, angle, marker tool, tool offset and text are entered as information blocks in the command string. Each section or information block in the command string is separated by a space. The format of this command code is outlined as follows:

Note: If a value is not present for a specific information block, the default values will be used. The default values are:

Font (F): Internal Angle (A): 0 Offset (O): #1 Scale (S): One Marker (M): #1 Example of a simple command string:

< The program command must begin with the “<” symbol to indicate that the

Marker Font Generator feature is being used.

F The first block of information is the Font Source location. The “F” is followed by

a digit to indicate the location where the font is stored: 1 = an internal font in the control software 2 = a font located on the CNC hard drive 3 = a font from diskette or USB memory. If no font is found at the selected location, the default internal font will be used.

For the example given, the font location would be from the hard drive.

S The second information block determines the scale of the text. The “S” is

followed by a number that indicates the scale factor. For the example given, the scale factor is twice the original font dimensions.

A The third information block determines the angle of the text. The “A” is followed

by a number that indicates the degree of angle. For the example given, the

7-1

Programmer’s Reference

degree of the angle is 45.

M The fourth information block determines the Marker Tool to be used. The “M” is

followed by the number of the marker tool (Marker Enable Output) to be used. Up to two marker enables are supported.

O The fifth information block determines which tool Offset to be used. The “O” is

followed by a number indicates that one of the nine different tool offsets previously configured in control setups is to be used. The example shown indicates that tool offset number two should be used.

< > The final information block is used to specify the marker text to be executed.

The text must be enclosed in the ”<” and “>” marks to be valid and understood as the selected text. For the example given, the marker text executed would be “TEST 123”

When the previous code example is translated by the CNC, it generates the Marker Text “TEST 123” onto the plate as shown here in Shape Wizard.

To improve the ease of use for the part program designer and control operator, the marker font generator always inserts a traverse segment to return to the original start point at the beginning of the marking text.

7-2

Marker Font Generator

Internal Fonts

The internal fonts located within the control software are 1” high and are limited to characters available on the control keypad. Alphabetical characters are limited to upper case letters only.

External Fonts

External fonts can be loaded from a floppy disk or from the control hard drive. When the CNC generates the text, the CNC searches for part files to correspond to the selected character. The part file names must be based on their ASCII numeric equivalent and have a .txt file extension.

For example, for the marker text “Ab 12”, the control searches for the following files to generate the text:

Text ASCII No. File Name

Capital A 65 Ascii65.txt Lower case b 98 Ascii98.txt Space 32 Ascii32.txt No 1 49 Ascii49.txt No 2 50 Ascii50.txt For more information on ASCII codes, refer to the ASCII Codes chapter.

Font programs may be saved on the control hard drive by creating a folder labeled “Fonts” using the “Save to Disk” feature and saving the font programs within this folder. Remember, if a corresponding part file to text requested is not found at the selected source location, the internal font file will be used.

Custom Fonts

Custom fonts can be used when using the marker font generator. To construct these font files, certain guidelines should be adhered to.

1. Programming format must be EIA

2. Only M09 and M10 can be used to enable and disable the marker.

3. Only G00, G01, G02 and G03 codes can be used.

4. The program must end in an M02.

5. The proper file name must be assigned to the font program.

6. The font program must begin in the lower left and end in the lower right.

7. Font programs should have the consistent dimensional limits (i.e. 1’ high, etc.).

7-3

Programmer’s Reference

Example: The letter “B” – File Name Ascii66.txt

M09 G01 X0 Y1 G01 X0.321429 Y0 G02 X0 Y-0.5 I0 J-0.25 G01 X-0.321429 Y0 M10 G00 X0.321429 Y0 M09 G02 X0 Y-0.5 I0 J-0.25 G01 X-0.321429 Y0 M10 G00 X0.571 Y0 M02

The darker lines in the drawing represent the Traverse segment and the lighter lines represent the Marking lines. You can see by this illustration that at the end of the font program, a traverse is used to continue motion to the bottom right corner.

Note: The Burny 3/5 style of programming for the Marker Font Generator feature is also supported for the default internal font source.

7-4

Sensor THC Programming Support

The Sensor THC allows you to configure THC setup parameters through part program codes.

The following parameters are available using EIA-274D G59 codes:

• Arc Voltage

• Pierce / Start Time

• Pierce/ Start Height Factor

• Cut / Mark Height

• Transfer Height Factor Use the following format to set up the Sensor THC in a part program:

G59 V601 Fvalue

G59 Any G Code V6xx Variable Identity:

V600 = Plasma 1 Arc Voltage V601 = Plasma 1 Pierce Time V602 = Plasma 1 Pierce Height Factor V603 = Plasma 1 Cut Height V604 = Plasma 1 Transfer Height Factor V605 = Plasma 1 Cut Height Delay V606 = Plasma 1 Kerf Detect Reaquire Time V625 = Plasma 2 Arc Voltage V626 = Plasma 2 Pierce Time V627 = Plasma 2 Pierce Height Factor V628 = Plasma 2 Cut Height V629 = Plasma 2 Transfer Height Factor V630 = Plasma 2 Cut Height Delay V631 = Plasma 2 Kerf Detect Reaquire Time V650 = Marker 1 Arc Voltage V651 = Marker 1 Start Time V652 = Marker 1 Start Height Factor V653 = Marker 1 Mark Height V675 = Marker 2 Arc Voltage V676 = Marker 2 Start Time

8-1

Programmer’s Reference

V677 = Marker 2 Start Height Factor V678 = Marker 2 Mark Height

Fvalue Variable Value

The selected value for the variable

THC Index Code

G00 Zx.xx Tx Index Sensor THC height “Z” distance for torch “T”. Manual mode only.

8-2

Plasma Supply Programming Support

HPR and HD4070 Support

The same cut chart data that is used on the cut chart setup screen can also be used within a part program to configure the power supply for use. This code is used to select the set point for each variable.

Only the variables that you are changing need be inserted into the part program. You do not have to insert a line of code for each cut chart variable within a part program.

Part program codes for the power supply should be grouped together at the beginning of the program. The three variables that can be set through the part program are Material Type, Current Setting and Material Thickness.

Cut parameters for the power supply can be configured using the EIA-274D G59 code with the following format:

G59 V503 F5 G59 Any G code V5xx The variable identity:

V503 – Material Type Plasma 1 V513 – Material Type Plasma 2 V523 – Material Type Marker 1 V533 – Material Type Marker 2 V504 – Current Setting Plasma 1 V514 – Current Setting Plasma 2 V524 – Current Setting Marker 1 V534 – Current Setting Marker 2 V507 – Material Thickness Plasma 1 V517 – Material Thickness Plasma 2 V527 – Material Thickness Marker 1 V537 – Material Thickness Marker 2

9-1

Programmer’s Reference

Fx The variable value, which depends on the variable identity:

For material type V503, V513, V523, V533:

Add .0x for Specific Material x (for example: V503 F1 .01 for mild steel, specific material 1)

1 = Mild Steel 2 = Stainless Steel 3 = Aluminum

For current setting V504, V514, V524, V534:

7 = 7A 70 = 70A 10 = 10A 80 = 80A 15 = 15A 100 = 100A 18 = 18A 130 = 130A 30 = 30A 200 = 200A 45 = 45A

For gas settings V505, V515, V525, V535:

1 = Air/Air 9 = H35/N2 17 = O2-N2/O2 2 = O2/Air 10 = H5/N2 18 = O2 3 = O2/O2 11 = Air/N2 19 = N2 5 = N2/CO2 13 = CO2/N2 21 = Air 6 = None/N2 14 = None/Air 22 = F5/N2 7 = O2/N2 15 = CH4/Air 23 = H35&N2/N2 8 = CH4 / N2 16 = O2-N2/Air

9-2

Plasma Supply Programming Support

For material thickness V507, V517, V527, V537:

EIA Fnumber

Gauge and Fraction

Decimal Metric

1 None None None 2 or 3 28GA 0.015” 0.35mm 4 or 5 27GA 0.016” 0.4mm 6 or 7 26GA 0.018” 0.5mm 8 or 9 24GA 0.024” 0.6mm 10 or 11 22GA 0.030” 0.8mm 12 or 13 20GA 0.036” 0.9mm 14 19GA 0.040” 1mm 15 or 16 18GA 0.048” 1.2mm 17 or 18 16GA 0.060” 1.5mm 19 1/16” 0.063” 1.6mm 20 or 21 14GA 0.075” 2mm 47 13GA 0.090” 2.2mm 22 3/32” 0.094” 2.4mm 23 or 24 12GA 0.105” 2.5mm 48 11GA 0.120” 3mm 25 1/8” 0.125” 3.2mm 26 or 27 10GA 0.135” 3.5mm 49 9GA 0.150” 3.8mm 52 8GA 0.164” 4mm 50 7GA 0.180” 4.5mm 28 3/16” 0.188” 4.8mm

9-3

Programmer’s Reference

53 6GA 0.194” 5mm 51 5GA 0.210” 5.5mm 29 1/4” 0.25” 6mm 30 5/16” 0.313” 8mm 31 3/8” 0.375” 10mm 32 7/16” 0.438” 11mm 33 1/2” 0.5” 12mm 34 9/16” 0.563” 14mm 35 5/8” 0.625” 15mm 36 3/4” 0.75” 20mm 37 7/8” 0.875” 22mm 38 1” 1” 25mm 39 1 1/8” 1.125” 30mm 40 1 1/4” 1.25” 32mm 41 1 3/8” 1.375” 35mm 42 1 1/2” 1.5” 38mm 54 1 5/8” 1.625” 40mm 43 1 3/4” 1.75” 45mm 55 1 7/8” 1.875” 48mm 44 2” 2” 50mm 56 2 1/8” 2.125” 55mm 45 2 1/4” 2.25” 60mm 46 2 1/2” 2.5” 65mm 57 2 3/4” 2.75” 70mm 58 3” 3” 75mm

9-4

Plasma Supply Programming Support

59 3 1/8” 3.125” 80mm 60 3 1/4” 3.25” 85mm 61 3 1/2” 3.5” 90mm 62 3 3/4” 3.75” 95mm

Note: Programming a code for a nonexistent process will result in an invalid process.

HD3070 Support

The same valve setting data that is used on the Auto Gas setup screen can also be used within a part program to configure the HD3070. This code is used to select the valve and indicate the valve set point.

Use a EIA-274D G59 code with the following format:

G59 V65 B5 G59 Any G code Vxx The valve identity:

V65 = Preflow Shield Gas - Valve 1 V66 = Preflow Shield Gas - Valve 2 V67 = Cut Shield Gas - Valve 3 V68 = Cut Shield Gas - Valve 4

63 4” 4” 100mm

V69 = Cut Plasma Gas - Valve 5 V70 = Cut Plasma Gas - Valve 6 V71 = Remote Plasma Gas Type

Bx The valve value, which depends on the valve identity:

For Valves V65 – V70, a whole integer is used to set the desired percentage value.

For Valve 71:

0 = Oxygen 1 = H35/N2 2 = Air

9-5

Programmer’s Reference

For this example, the part program code (G59 V65 B5) would set the autogas preflow shield gas valve to 5%. Multiple G59 codes can be used to set and adjust all the necessary valves.

FineLine Support

The same Cut Chart data which is used at the Cut Chart setup screen may also be used within a part program to configure the FineLine power supply. This code is used to select the set point for each variable.

It is not necessary to have a line of code for each cut chart variable within a part program. Only those variables that are changing need be inserted into the part program (e.g. Material Thickness or Material Type).

Part program codes for the FineLine should be grouped together at the beginning of the program. The three variables which can be set through the part program are Material Type, Current Setting and Material Thickness.

Configure cut parameters for the FineLine using an EIA-274D G59 code with the following format:

G59 V503 F5 G59 Any G code Vxxx

The variable identity:

Fx The variable value, which depends on the variable identity:

For material type V503, V513, V523, V533:

Add .0x for Specific Material x (for example: V503 F1 .01 for mild steel, specific material 1)

9-6

Plasma Supply Programming Support

1 = Mild Steel 2 = Stainless Steel 3 = Aluminum

For current setting V504, V514, V524, V534:

8 = 8A 50 = 50A 9 = 9A 70 = 70A 10 = 10A 100 = 100A 30 = 30A 200 = 200A

For material thickness V507, V517, V527, V537:

EIA Fnumber

Gauge and Fraction

Decimal Metric

9-7

Programmer’s Reference

48 11GA 0.120” 3mm 25 1/8” 0.125” 3.2mm 26 or 27 10GA 0.135” 3.5mm 49 9GA 0.150” 3.8mm 52 8GA 0.164” 4mm 50 7GA 0.180” 4.5mm 28 3/16” 0.188” 4.8mm 53 6GA 0.194” 5mm 51 5GA 0.210” 5.5mm 29 1/4” 0.25” 6mm 30 5/16” 0.313” 8mm 31 3/8” 0.375” 10mm 32 7/16” 0.438” 11mm 33 1/2” 0.5” 12mm 34 9/16” 0.563” 14mm 35 5/8” 0.625” 15mm 36 3/4” 0.75” 20mm 37 7/8” 0.875” 22mm 38 1” 1” 25mm 39 1 1/8” 1.125” 30mm 40 1 1/4” 1.25” 32mm 41 1 3/8” 1.375” 35mm 42 1 1/2” 1.5” 38mm 54 1 5/8” 1.625” 40mm 43 1 3/4” 1.75” 45mm

9-8

Plasma Supply Programming Support

55 1 7/8” 1.875” 48mm 44 2” 2” 50mm 56 2 1/8” 2.125” 55mm 45 2 1/4” 2.25” 60mm 46 2 1/2” 2.5” 65mm 57 2 3/4” 2.75” 70mm 58 3” 3” 75mm 59 3 1/8” 3.125” 80mm 60 3 1/4” 3.25” 85mm 61 3 1/2” 3.5” 90mm 62 3 3/4” 3.75” 95mm 63 4” 4” 100mm

9-9

Programmer’s Reference

9-10

Serial Messaging

The Serial Messaging feature may be used to pass commands embedded within a part program through a selected serial port to an external device. Both RS-232 and RS-422 are supported. TCP/ IP protocol is not supported at this time. There are 2 Serial Messaging ports available.

Overview

Serial Messaging has a fairly basic communication protocol that has three simple formats to send ASCII codes as command strings. During the messaging function, a status indicator for “Message Transmit”, “Message Delay” or “Message Verify” will be displayed in the Watch window.

Options

• While the selected message is sent to the external device, the part program will be

temporarily suspended. After completion of the transmission, the part program will then automatically resume. No acknowledgement from the external device is required. An additional Time Delay may also be added.

• A message is sent concurrent to execution of the part program and no delay is

encountered. No acknowledge is required. No Delay Time is allowed.

• The message is sent with a suspension of the program during transmission as in the

first option, but an Acknowledge from the external device (ACK) is required before the part program can continue. A Non-Acknowledge (NAK) response from the external device will prompt a retransmit of the message from the control. An optional Time Out value may be added to the program code. If no Time Out code is used in the program code the Default time out value at the Ports setup screen will be used. Additionally, an optional automatic retry feature may be enabled at the Ports setup screen.

To enable use of this feature, assign Messaging to the selected port(s) at the Ports setup screen.

After you enable serial messaging, the flow control parameters that communicate with the external device must be selected.

10-1

Programmer’s Reference

The following parameters must be configured. Hardware and flow control configuration information must match the external device.

Time Out The Time Out value may be used for the Message Type 22 (which

requires an acknowledgement from the external device after the message) if there is no Time Out value used in the command string of

the program code. Baud Rate Select a communication speed from 1200 to 115200 Baud. Flow Control Select to use None, Xon/Xoff or Hardware. During Jog on

Path

Select whether messages will be sent when jogging Forward or

Backward on Path while at the Pause screen.

Notes:

• All messaging will stop when the Stop Key has been pressed or the Remote Pause input becomes active.

• The Message Type 21 will transmit the message concurrent to the associated motion segment during Backup on Path.

Parity Select None, Odd or Even.

10-2

Data Bits Select 7 or 8 Data Bits.

Serial Messaging

Retry on Time Out

For the Message Type 22 (which requires an acknowledgement from the external device after the message) an automatic retransmit of the message may be sent. The user may select the number of retries allowed before faulting from a lack of response from the external device. The fault prompt “Message Error” will be displayed when in a Time Out condition.

Programming Code

The ASCII message string follows a unique program message format. Each command begins with a “>” character and ends with a “<” character. These characters are used as delimiters to frame the command (Message Type, Optional Format and Optional Delay Time/Time Out) instructions for the message.

Message Information The format of this command code is outlined as follows:

>20+Format+Delay Time/Time Out+Port<Message

>2x Message Command type (see Message Command Type section):

>20 = Direct message with Delay >21 = Direct message without Delay >22 = Message that requires Acknowledge

Format Optional format value that allows the user to add:

Line Feed and Carriage Return commands, etc., message string.

0,1,16,17,32,33,48,49,64,65,80,81,96,97,112,113 are supported (see Format Value section).

Delay Time/ Time Out

Port Optional serial port number:

Message The message content (see the message text section.)

Optional delay time/time out value

Time in seconds (see Time Out Value section.)

0 = Default port 1 1 = Port 2

Note: Serial message format is always written within comment characters and the command portion of the program code is between the “>” Character and the “<” Character.

10-3

Programmer’s Reference

ESSI Example:

3 >20,1,1,0<Message 4

EIA Example:

(>20,1,1,0<Message)

Note: You can use the plus sign (+), hyphen (-), comma (,) or space as a delimiter between fields for the command instruction.

Message Command Type

>20< This command delays the part program until all bytes have been

transmitted, then optionally waits the Delay Time, if specified.

>21< A message is sent concurrent to execution of the part program and no

delay is encountered. No acknowledge is required.

>22< The message is sent with a suspension of the program during

transmission as in option one, but an Acknowledge from the external device (ACK = Hexadecimal 06) is required before the part program can continue. A nonacknowledge (NAK = Hexadecimal 15) response from the external device will prompt a retransmit of the message from the control.

An optional Time Out value may be added to the program code. If no Time Out code is used in the program code the Default time out value at the Ports setup screen will be used. Additionally, an optional automatic retry feature may be enabled at the Ports setup screen.

With the automatic retry feature the message will automatically be retransmitted if no response is detected. The retry is executed after the Time Out value has elapsed. The number of retries can be defined on the Ports configuration screen.

10-4

Serial Messaging

Optional Format Value

The following specialty characters for the format can be sent, in addition to a command string.

Specialty Characters Supported

HEX Name Description

01 SOH Start of Header 02 STX Start of Text 03 ETX End of Text 04 EOT End of Transmission 0A LF Line Feed 0D CR Carriage Return BCC “Exclusive Or” Check Byte Note: Checksum is always an 'Exclusive OR' of the Data because it does not include

any of the 'Format' characters, including the CR/LF option.

Optional Format Character Assignments

Value Assignment 0 No special assignment (must be used in the format location if a Delay

or Port is required but no Format options are required). Append a Carriage Return (<CR> = Hex value OD) and a Line Feed

(<LF> = Hex Value0A). 16 Append an “Exclusive OR” (<BCC>) to the end of the message. 17 Appends a combination of 16 and 1. 32 Encloses the message with Start of Text (<STX> = Hex Value 02) and

End of Text (<ETX> = Hex Value 03).

The <ETX> follows the message and the optional <CR><LF>>

append codes but precedes the Check Byte <BCC>. 33 Appends a combination of 1 and 32. 48 Appends a combination of 16 and 32.

10-5

Programmer’s Reference

49 Appends a combination of 1, 16 and 32. 64 Append a Start of Header (<SOH> = Hex value 01) and an End of

Transmission (<EOT> = Hex Value04) to the message. 65 Appends a combination of 1and 64. 80 Appends a combination of 16 and 64. 81 Appends a combination of 1, 16 and 64. 96 Appends a combination of 32 and 64. 97 Appends a combination of 1, 32, and 64. 112 Appends a combination of 16, 32 and 64. 113 Appends a combination of 1, 16, 32 and 64.

Optional Delay Time/Time Out Value

The Delay Value issues a delay in seconds at the end of the message for Message Type 20.

No delay is supported for Message Type 21. This value also works as a Time Out value for Message Type 22. An error will be

displayed if the message is not acknowledged (ACK Hexadecimal 06) within the specified time. If no Time Out Delay is defined in the command, the Time Out parameter on the Ports screen will be used.

The value is in a 3.2 format where a value of 5 is equal to 5.00 seconds. Accepted limits for the value is range of 0.00 to 999.99 seconds.

If there is no delay, but the optional port below is being selected, then 0 is required to be entered in the optional delay location.

Optional Port

The Optional Port setting selects which Messaging Port to use. The default messaging port to use is Port 1 if this parameter is omitted. If the optional port is used, 0 = Messaging Port 1 and 1 = Messaging Port 2.

Message Text Content

Up to 300 data characters in each command string may be sent. The Command characters (information between and including the “>” and “<” signs) are included in this maximum.

Printable and Non- Printing ASCII codes can be used in the message string. For more information on ASCII codes and the Hexadecimal value, refer to the ASCII Code chapter.

10-6

Serial Messaging

Non-printing characters are supported by use of a two-character command and can send a Binary Code in the Range from 0-255. Double byte character to support combinations will affect the maximum length count with each pair reducing the maximum data characters by 1. For more information on these values, refer to the Nonprinting Character section.

Non-Printing Characters

Non Printing Characters are supported through use of a pair of two printing codes to equal the non-printing code. This pair of characters is retained in the program code but sent as single 8-bit code when transmitted.

There are three types of character pairs and each performs a different operation based on the first character of the pair. This produces a single modified character for transmission.

Character Options

• The “&” two-character pair clears the 0x40 bit from the 2nd character code value.

• The “!” two-character pair clears the 0x40 bit and sets the 0x80 bit set in the 2nd

character code.

• The “$” two-character pair clears the 0xC0 bit in the 2nd character. To transmit the single character with a value 0x01, use the two-character sequence

”&A”. This converts the “A” value of 0x41 to 0x01 by clearing the 0x40 bit. To transmit 0x81, use “!A” or to transmit 0xC1, use “$A”.

Exceptions / Additions

As the “&”, “!” and “$” are used as key indicators for the non-print characters, there is a special format used when these characters are used as a print character in the message text. Simply use the character twice. “&&” = “&”

The ESSI style part program uses several unique characters which requires special two character codes to be used. For example, the message code “&K” in the part program will transmit the code value of 0x2B which is the ASCII code for the plus sign (+). In order to send the + character the code “&K” must be used.

The following are unique codes used in WORD ADDRESS and ESSI programs. Code Code Value Description &’ 0x20=space At end of ESSI program &h 0x28 = “(“ To transmit “(” from WORD ADDRESS program &i 0x29 = “)“ To transmit “)” from WORD ADDRESS program &? 0x7F = DEL Non-printable DELETE code &K 0x2B = “+” To transmit “+” from ESSI program

10-7

Programmer’s Reference

Non-Printing Character Table

ASCII Codes Less Than Hexadecimal 20

Code Hex Code Hex Code Hex Code Hex &@ 00 &H 08 &P 10 &X 18 &A 01 &I 09 &Q 11 &Y 19 &B 02 &J 0A &R 12 &Z 1A &C 03 &K 0B &S 13 &[ 1B &D 04 &L 0C &T 14 &\ 1C &E 05 &M 0D &U 15 &] 1D &F 06 &N 0E &V 16 &^ 1E &G 07 &O 0F &W 17 &_ 1F

8 bit Character Codes Greater Than Hexadecimal 80

Code Hex Code Hex Code Hex Code Hex !@ 80 !H 88 !P 90 !X 98 !A 81 !I 89 !Q 91 !Y 99 !B 82 !J 8A !R 92 !Z 9A !C 83 !K 8B !S 93 ![ 9B !D 84 !L 8C !T 94 !\ 9C !E 85 !M 8D !U 95 !] 9D !F 86 !N 8E !V 96 !^ 9E !G 87 !O 8F !W 97 !_ 9D

!` A0 !h A8 !p B0 !x B8 !a A1 !I A9 !q B1 !y B9 !b A2 !j AA !r B2 !z BA

10-8

Serial Messaging

!c A3 !k AB !s B3 !; BB !d A4 !l AC !t B4 !< BC !e A5 !m AD !u B5 != BD !f A6 !n AE !v B6 !> BE !g A7 !o AF !w B7 !? BF

$@ C0 $H C8 $P D0 $X D8 $A C1 $I C9 $Q D1 $Y DD $B C2 $J CA $R D2 $Z DA $C C3 $K CB $S D3 $[ DB $D C4 $L CC $T D4 $\ DC $E C5 $M CD $U D5 $] DD $F C6 $N CE $V D6 $^ DE $G C7 $O CF $W D7 $_ DF

$` E0 $h E8 $p F0 $x F8 $a E1 $I E9 $q F1 $y F9 $b E2 $j EA $r F2 $z FA $c E3 $k EB $s F3 $; FB $d E4 $l EC $t F4 $< FC $e E5 $m ED $u F5 $= FD $f E6 $n EE $v F6 $> FE $g E7 $o EF $w F7 $? FF

10-9

Programmer’s Reference

10-10

Importing Prepared DXF Files

The DXF Translator software allows the control to load and translate a DXF style drawing created in Autocad ® or Autocad LT® into an EIA part program. Certain guidelines must be observed when creating the CAD drawing to allow the control to load and understand the file. The optional DXF translation utility is enabled through a password provided by your control supplier.

Drawing Format

There should be nothing on the cut layer except lines, arcs, circles and text commands. Do not put dimensions or notes on the same layer as cut data.

Elliptical segments, squares and polylines are not supported. Divide these elements into short arcs or line segments. You can use the ACAD EXPLODE command to convert POLYLINES into segments.

The end angles of two arcs from any intersection point cannot be within the same quadrant.

Text commands determine cut sequence, and determine the path through multisegment intersections. Text commands are placed on the drawing with the text feature of your CAD program. The size of the text is not important. However, the location of the text is extremely important. Text must be left-justified and text commands must be snapped to the appropriate intersection or pierce points.

Text commands indicate pierce points and cut direction. Note that the directional commands should only be used to determine the direction of the next line segment when more than one exit path exists at an intersection of segments.

Text Commands

1 Indicates the first pierce point (subsequent pierce points follow in numerical order) + Indicates a Counter-Clockwise circle

- Indicates a Clockwise circle

Directional Commands

The following commands indicate the next segment’s direction, if it is a line, or the ending angle, if it is an arc, if the angle is:

R 350° to 10° RU 0° to 45° UR 45° to 90° U 80° to 100° UL 90° to 135° LU 135° to 180°

11-1

Programmer’s Reference

L 170° to 190° LD 180° to 225° DL 225° to 270° D 260° to 280° DR 270° to 315° RD 315° to 360°

Traverses are automatically determined between pierce points and do not need to be entered on the CAD drawing.

The following example is a basic bolt hole rectangle with the lead-in and lead-out for the rectangle as part of the top and side line segments. The numbers indicate the order of the pierces and the “+” sign indicates a counter-clockwise rotation for the circles.

If the lead-in and lead-out are created as additional line segments added to the top and side line segments, additional text is required to indicate which direction the next line segment should take as part of the part program, as shown in the following diagram:

11-2

Importing Prepared DXF Files

In this example, the letter “R” has been snapped to the intersection of the four line segments to indicate that the next line segment after lead-in (pierce 5) would be the segment which is located at 350 to 10 degrees and then to the other connected segments on the square. After the left side (vertical) segment has been cut, no additional text is required to indicate which line should be cut. The Lead-out segment is the only segment left to cut because the lead-in and the first segment have already been cut.

Notes:

• There should be nothing on the cut layer except lines, arcs, circles and text or directional commands.

• Line segments must be connected to complete the cut path.

• If multiple line segments or arcs need to be repeated, each line segment should be

drawn, rather than copied and pasted.

• Features for marking are not available.

• No traverse lines are required. All lines in the CAD drawing are assumed to be cut

lines.

• Left kerf is assumed.

11-3

Programmer’s Reference

11-4



PrintedintheUSA



806270‐000

Hypertherm Automation Family Instruction Manual (IM)

Specifications and Main Features

Frequently Asked Questions

User Manual